Acoustic and Shock Loads

Incident Wave Loading due to External Sources

Abaqus provides a type of distributed load for loads due to external wave sources. Individual spherical monopole or individual or diffuse planar sources can be defined, subjecting the fluid and solid region of interest to an incident field of waves. Waves produced by an explosion or sound source propagate from the source, impinging on and passing over the structure, producing a temporally and spatially varying load on the structural surface. In the fluid the pressure field is affected by reflections and emissions from the structure as well as by the incident field from the source itself. The incident wave loads on acoustic and/or solid meshes depend on the location of the source node, the properties of the propagating fluid, and the reference time history or frequency dependence specified at the reference (“standoff”) node as indicated in Figure 1.

Several distinct modeling methods can be used in Abaqus with incident wave loading, requiring different approaches to applying the incident wave loads. For problems involving solid and structural elements only (for example, where the incident wave field is due to waves in air) the wave loading is applied roughly like a distributed surface load. This might apply to an analysis of blast loads in air on a vehicle or building (see Example: Airblast Loading on a Structure, shown in Figure 6). In Abaqus/Explicit the CONWEP model can be used for air blast loading on solid and structural elements, without the need to model the fluid medium. Deformation of a sandwich plate under CONWEP blast loading is an example of a blast loading problem.

Incident wave loads (with the exception of CONWEP loading) can be applied to beam structures as well; this is a common modeling method for ship whipping analysis and for steel frame buildings subject to blast loads. Incident wave loads can be applied to surfaces defined on two- or three-dimensional beam elements. However, incident wave loads can be applied only to three-dimensional beams for transient dynamic analysis where beam fluid inertia is defined. Incident wave loads cannot be defined on frame elements, line spring elements, three-dimensional open-section beam elements, or three-dimensional Euler-Bernoulli beams.

In underwater explosion analyses (for example, a ship or submerged vehicle subjected to an underwater explosion loading as depicted in Figure 4 and Figure 5) the fluid is also discretized using a finite element model to capture the effects of the fluid stiffness and inertia. For these problems involving both solid and acoustic elements, two formulations of the acoustic pressure field exist. First, the acoustic elements can be used to model the total pressure in the medium, including the effects of the incident field and the overall system's response. Alternatively, the acoustic elements can be used to model only the response of the medium to the wave loads, not the wave pulse itself. The former case will be referred to as the “total wave” formulation, the latter as the “scattered wave” formulation.

Incident wave interactions are also used to model sound fields impinging on structures or acoustic domains. The acoustic field scattered by a structure or the sound transmitted through the structure may be of interest. Usually, sound scattering and transmission problems are modeled using the scattered formulation with steady-state dynamic procedures. Transient procedures can also be used, in a manner analogous to underwater explosion analysis problems.

Scattered and Total Wave Formulations

The distinction between the total wave formulation and the scattered wave formulation is relevant only when incident wave loads are applied. The total wave formulation is more closely analogous to structural loading than the scattered wave formulation: the boundary of the acoustic medium is specified as a loaded surface, and a time-varying load is applied there, which generates a response in the acoustic medium. This response is equal to the total acoustic pressure in the medium. The scattered wave formulation exploits the fact that when the acoustic medium is linear, the response in the medium can be decomposed into a sum of the incident wave and the scattered field. The total wave formulation must be used when the acoustic medium is nonlinear due to possible fluid cavitation (see Loading due to an incident dilatational wave field).

Table 1 describes the procedure types for which each formulation is supported.

Table 1. Supported procedures for scattered and total wave formulations.
Procedure	Scattered	Total Wave
Steady-state dynamics	Yes	No
Transient	Yes	Yes

Scattered Wave Formulation

When the mechanics of a fluid can be described as linear, the observed total acoustic pressure can be decomposed into two components: the known incident wave and the “scattered” wave that is produced by the interaction of the incident wave with structures and/or fluid boundaries. When this superposition is applicable, it is common practice to seek the “scattered” wave field solution directly. When using the scattered wave formulation, the pressures at the acoustic nodes are defined to be only the scattered part of the total pressure. Both acoustic and solid surfaces at the acoustic-structural interface should be loaded in this case.

When using incident wave loads in steady-state dynamic procedures, the scattered wave formulation must be used.

Input File Usage

Use the following option to specify the scattered wave formulation (default):

ACOUSTIC WAVE FORMULATION, TYPE=SCATTERED WAVE

Abaqus/CAE Usage

Any module: ModelEdit Attributesmodel_name. Toggle on Specify acoustic wave formulation: select Scattered wave

Total Wave Formulation

The total wave formulation (see Coupled acoustic-structural medium analysis) is particularly applicable when the acoustic medium is capable of cavitation, rendering the fluid mechanical behavior nonlinear. It should also be used if the problem contains either a curved or a finite extent boundary where the pressure history is prescribed. Only the outer acoustic surfaces should be loaded with the incident wave in this case, and the incident wave source must be located exterior to the fluid model. Any impedance or nonreflecting condition that may exist on this outer acoustic boundary applies only on the part of the acoustic solution that does not include the prescribed incident wave field (that is, only the scattered field is subject to the nonreflecting condition). Thus, the applied incident wave loading will travel into the problem domain without being affected by the nonreflecting conditions on the outer acoustic surface.

In the total wave formulation the acoustic pressure degree of freedom stands for the total dynamic acoustic pressure, including contributions from incident and scattered waves and, in Abaqus/Explicit, the dynamic effects of fluid cavitation. The pressure degree of freedom does not include the acoustic static pressure, which can be specified as an initial condition (see Defining Initial Acoustic Static Pressure). This acoustic static pressure is used only in determining the cavitation status of the acoustic element nodes and does not apply any static loads to the acoustic or structural mesh at their common wetted interface. It does not apply to analyses using Abaqus/Standard.

Input File Usage

Use the following option to specify the total wave formulation:

ACOUSTIC WAVE FORMULATION, TYPE=TOTAL WAVE

Abaqus/CAE Usage

Any module: ModelEdit Attributesmodel_name. Toggle on Specify acoustic wave formulation: select Total wave

Initialization of Acoustic Fields

For transient dynamics, when the total wave formulation is used with the incident wave standoff point located inside the acoustic finite element domain, the acoustic solution is initialized to the values of the incoming incident wave. This initialization is performed automatically, for pressure-based incident wave amplitude definitions only, at the beginning of the first direct-integration dynamic step in an analysis; in restarted analyses, steps are counted from the beginning of the initial analysis. This initialization not only saves computational time but also applies the incident wave loading without significant numerical dissipation or distortion. During the initialization phase all incident wave loading definitions in the first dynamic analysis step are considered, and all acoustic element nodes are initialized to the incident wave field at time zero. Incident wave loads specified with different source locations count as separate load definitions for the purpose of initialization of the acoustic nodes. Any reflections of the incident wave loads are also taken into account during the initialization phase.

Describing Incident Wave Loading

To use incident wave loading, you must define the following:

information that establishes the direction and other properties of the incident wave,
the time history or frequency dependence of the source pulse at some reference (“standoff”) point,
the fluid and/or solid surfaces to be loaded, and
any reflection plane outside the problem domain, such as a seabed in an underwater explosion study, that would reflect the incident wave onto the problem domain.

Two interfaces are available in Abaqus for applying incident wave loads: a preferred interface that is supported in Abaqus/CAE and an alternative interface that has been available in previous releases and is not supported in Abaqus/CAE. The preferred interface is conceptually the same as the alternative interface and uses essentially the same data. The preferred interface options include the term “interaction” to distinguish them from the incident wave and incident wave property options of the alternative interface. Unless otherwise specified, the discussion in this section applies to both of the interfaces. The usages for the preferred interface are included in the discussion; the usages for the alternative interface are described in Alternative Incident Wave Loading Interface below. Refer to the example problems discussed at the end of this section to see how the incident wave loading is specified using the preferred interface.

Prescribing Geometric Properties and the Speed of the Incident Wave

You must refer to a property definition for each prescribed incident wave. Incident wave loads in Abaqus may be either planar, spherical, or diffuse. You select a planar incident wave (default), spherical incident wave, or a diffuse field in the incident wave property definition.

Planar incident waves maintain constant amplitude as they travel in space; consequently, the speed and direction of travel are the critical parameters to define. The speed is defined in the incident wave interaction property definition, and the direction is determined by the locations of the source and standoff points you define as part of the incident wave interaction.

For spherical incident wave definitions, the wave reduces in amplitude as a function of space. By default, the amplitude of a spherical wave is inversely proportional to the distance from the source; this behavior is called “acoustic” propagation. For the preferred interface you can modify the default propagation behavior to define spatial decay of the incident wave field. The dimensionless constants $A$ , $B$ , and $C$ are used to define the spatial decay as a function of the distance $R_{j}$ between the source point and the loaded point and the distance $R_{0}$ between the source point and the standoff point:

$p_{x} (R_{0}, R_{j}) \equiv {(\frac{R_{0}}{R_{j}})}^{[\frac{(A + 1) R_{j}}{C R_{0} + (B + 1) R_{j}}]} .$

Refer to Loading due to an incident dilatational wave field for details of the generalized spatial decay formulation.

In Abaqus incident wave interactions can be used to simulate diffuse incident fields. Diffuse fields are characteristic of reverberant spaces or other situations in which waves from many directions strike a surface. For example, reverberant chambers are constructed intentionally in acoustic test facilities for sound transmission loss measurements. The diffuse field model used in Abaqus, as shown in Figure 2, allows you to specify a seed number $N$ ; $N^{2}$ deterministic incident plane waves travel along vectors distributed over a hemisphere so that the incident power per solid angle approximates a diffuse incident field.

The fluid and the solid surfaces where the incident loading acts are specified in the incident wave loading definition. The incoming wave load is further described by the locations of its source point and of a reference (“standoff”) point where the wave amplitude is specified. For information on how to specify these surfaces and the standoff point, see Identifying the Fluid and the Solid Surfaces for Incident Wave Loading and The Standoff Point below. For a planar wave the specified locations of the source and the standoff points are used to define the direction of wave propagation.

The speed of the incident wave is prescribed by giving the properties for the incident wave-bearing acoustic medium. These specified properties should be consistent with the properties specified for the fluid discretized using acoustic elements.

For the preferred interface you must define nodes corresponding to the source and standoff points for the incident wave; the node numbers or set names must be specified for each incident wave definition. The node set names, if used, must contain only a single node. Neither the source node nor the standoff node should be connected to any elements in the model.

Input File Usage

INCIDENT WAVE INTERACTION PROPERTY, 
NAME=wave property name, TYPE=PLANE or SPHERE
speed of sound, fluid mass density, A, B, C
INCIDENT WAVE INTERACTION, PROPERTY=wave property name
fluid surface name, source node, standoff node, reference magnitude

The constants A, B, and C apply only for spherical incident waves with generalized spatial decay propagation.

INCIDENT WAVE INTERACTION PROPERTY, 
NAME=wave property name, TYPE=DIFFUSE
speed of sound, fluid mass density
INCIDENT WAVE INTERACTION, PROPERTY=wave property name
fluid surface name, source node, standoff node, reference magnitude, N

The seed number N generates planar incident waves with directions distributed on a hemisphere centered at the standoff point.

Abaqus/CAE Usage

Interaction module: Create Interaction Property: Name: wave property name and Incident wave, Speed of sound in fluid: speed of sound, Fluid density: fluid mass density

Select one of the following definitions:

Definition: Planar
Definition: Spherical, Propagation model: Acoustic
Definition: Spherical, Propagation model: Generalized decay, 
enter values for A, B, and C
Definition: Diffuse, Seed number: N

Create Interaction: Incident wave: select the source point, select the standoff point, select the region: Wave property: wave property name, Reference magnitude: reference magnitude

Identifying the Fluid and the Solid Surfaces for Incident Wave Loading

In the scattered wave formulation the incident wave loading must be specified on all fluid and solid surfaces that reflect the incident wave with two exceptions:

those fluid surfaces that have the pressure values directly prescribed using boundary conditions; and
those fluid surfaces that have symmetry conditions (the symmetry must hold for both the loading and the geometry).

In problems with a fluid-solid interface both surfaces must be specified in the incident wave loading definition for the scattered formulation. See Example: Submarine Close to the Free Surface, shown in Figure 4.

When the total pressure-based formulation is specified, the incident wave loading must be specified only on the fluid surfaces that border the infinite region that is excluded from the model. Typically, these surfaces have a nonreflecting radiation condition specified on them, and the implementation ensures that the radiation condition is enforced only on the scattered response of the modeled domain and not on the incident wave itself. See Example: Submarine Close to the Free Surface and Example: Surface Ship, shown in Figure 4 and Figure 5, respectively.

In certain problems, such as blast loads in air, you may decide that the blast wave loads on a structure need to be modeled, but the surrounding fluid medium itself does not. In these problems the incident wave loading is specified only on the solid surfaces since the fluid medium is not modeled. The distinction between the scattered wave formulation and the total wave formulation for handling the incident wave loading is not relevant in these problems since the wave propagation in the fluid medium is of no interest.

The Standoff Point

In transient analyses the standoff point is a reference point used to specify the pulse loading time history: it is the point at which the user-defined pulse history is assumed to apply with no time delay, phase shift, or spreading loss. In steady-state analyses using discrete planar or spherical sources, the standoff point is the point at which the incident field has zero phase.

In transient analyses the standoff point should be defined so that it is closer to the source than any point on the surfaces in the model that would reflect the incident wave. Doing so ensures that all the points on these surfaces will be loaded with the specified time history of the source and that the analysis begins before the wave overtakes any portion of these surfaces. To save analysis time, the standoff point is typically on or near the solid surface where the incoming incident wave would be first deflected (see Example: Submarine Close to the Free Surface, shown in Figure 4). However, the standoff point is a fixed point in the analysis: if the loaded surfaces move before the incident wave loading begins, due to previous analysis steps or geometric adjustments, the surfaces may envelop the specified standoff point. Care should be taken to define a standoff point such that it remains closer to the incident wave source point than any point on the loaded surfaces at the onset of the loading.

When the total wave formulation is used and the incident wave loading is specified in the first step of the analysis in terms of pressure history, Abaqus automatically initializes the pressure and the pressure rate at the acoustic nodes to values based on the incident wave loading. This allows the acoustic analysis to start with the incident waves partially propagated into the problem domain at time zero and assumes that this propagation had taken place with negligible effect of any volumetric dissipative sources such as the fluid drag. When the incident wave loading is specified in terms of the pressure values, the recommendations given above for selecting a standoff point are valid with the total wave formulation as well. However, when the incident wave loading is specified in terms of acceleration values, the automatic initialization is not done and the standoff point should be located near the exterior fluid boundary of the model such that the standoff point is closer to the source than any point on the exterior boundary. See Example: Submarine Close to the Free Surface and Example: Surface Ship, shown in Figure 4 and Figure 5, respectively.

In steady-state analyses the role of the standoff point is somewhat different. When the incident wave interaction property is of planar or spherical type, you define the real and imaginary parts of the magnitude at the standoff point. Separately, the specified real and imaginary incident waves are taken to have zero phase at the standoff point (combined, these two waves could be equivalent to a single wave with nonzero phase at the standoff). Every location on the loaded surface has a phase shift in the applied pressure or acoustic traction, corresponding to the difference in propagation time between the loaded point and the standoff. This means that an incident wave defined, for example, with a pure real value at the standoff point generates both real and imaginary tractions at all the other points on the loaded surface.

When the incident wave is of diffuse type, the role of the standoff and source points is primarily to orient the loaded surface with respect to the incoming reverberant field. The model used for diffuse incident wave loading applies a set of deterministically defined plane waves, whose directions are defined as vectors connecting the standoff point and an array of points on a hemisphere. This hemisphere is centered at the standoff point, and its apex is the source point. The array of points is set according to the specified seed, $N$ , and a deterministic algorithm that arranges $N^{2}$ points on the hemisphere. The algorithm concentrates the points so that the incident waves in the diffuse field model are concentrated at normal incidence, with fewer waves at oblique angles. The specified amplitude value and reference magnitude are divided equally among the $N^{2}$ incident waves. The orientation of the hemisphere containing the incident waves in the diffuse model is the same for all of the points on the loaded surface—it does not vary with the local normal vector on the surface.

Defining the Amplitude of the Source Pulse

For transient analyses the time history to be specified by the user is that observed at the standoff point: histories at a point on the loaded surface are computed from the wave type and the location of that point relative to the standoff point. The time history of the acoustic source pulse can be defined either in terms of the fluid pressure values or the fluid particle acceleration values. Pressure time histories can be used for any type of element, such as acoustic, structural, or solid elements; acceleration time histories are applicable only for acoustic elements. In either case a reference magnitude is specified for any given incident-wave-loaded surface, and a reference to a time-history data table defined by an amplitude curve is specified. The reference magnitude varies with time according to the amplitude definition.

For steady-state dynamic analyses the amplitude definition specified as part of the incident wave interaction definition is interpreted as the frequency dependence of the wave at the standoff point.

Currently the source pulse description in terms of fluid particle acceleration history is limited to planar incident waves acting on fluid surfaces in transient analyses. Further, if an impedance condition is specified on the same fluid surface along with incident wave loading, the source pulse is restricted to the pressure history type even for planar incident waves. The source pulse in terms of pressure history can be used without these limitations; that is, pressure-history-based incident wave loading can be used with fluid or solid surfaces, with or without impedance, and for both planar and spherical incident waves.

When the source pulse is specified using pressure values and is applied on a fluid surface, the pressure gradient is computed and applied as a pressure-conjugate load on these surfaces. Hence, it is desirable to define the pulse amplitude to begin with a zero value, particularly when the cavitation in the fluid is a concern. If the structural response is of primary concern and the scattered formulation is being used, any initial jump in the pressure amplitude can be addressed by applying additional concentrated loads on the structural nodes that are tied to the acoustic mesh, corresponding to the initial jump in the incident wave pressure amplitude. Clearly, the additional load on any given structural node should be active from the instance the incident wave first arrives at that structural node. However, the scattered wave solution in the fluid still needs careful interpretation taking the initial jump into account.

Input File Usage

Use the following option to define the time history in terms of fluid pressure values:

INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=amplitude data table name
solid or fluid surface name, source node, standoff node, reference magnitude

Use the following option to define the time history in terms of fluid particle acceleration values:

INCIDENT WAVE INTERACTION, ACCELERATION AMPLITUDE=amplitude data table name
fluid surface name, source node, standoff node, reference magnitude

Use the following option to define the real part of the loading (default):

INCIDENT WAVE INTERACTION, REAL

Use the following option to define the imaginary part of the loading:

INCIDENT WAVE INTERACTION, IMAGINARY

Abaqus/CAE Usage

Interaction module: Create Interaction: Incident wave: select the source point, select the standoff point, select the region: Reference magnitude: reference magnitude

Use the following options to define the time history in terms of fluid pressure values or fluid particle acceleration values:

Definition: Pressure or Acceleration, Pressure amplitude or 
Acceleration amplitude: amplitude data table name

Use the following options to define the real or imaginary part of the loading:

Toggle on Real amplitude and/or Imaginary amplitude: amplitude data table name

Defining Bubble Loading for Spherical Incident Wave Loading

An underwater explosion forms a highly compressed gas bubble that interacts with the surrounding water, generating an outward-propagating shock wave. The gas bubble floats upward as it generates these waves changing the relative positions of the source and the loaded surfaces. The loading effects due to bubble formation can be defined for spherical incident wave loading by using a bubble definition in conjunction with the incident wave loading definition.

The bubble dynamics can be described using a model internal to Abaqus or by using tabulated data. Abaqus has a built-in mechanical model of the bubble interacting with the surrounding fluid, which is simulated numerically to generate a set of data prior to running the finite element analysis. You can specify the explosive material parameters, ending time, and other parameters that affect the computation of the bubble amplitude curve used, as shown in Table 2.

Table 2. Parameters that define the bubble behavior.
Name	Dimensions	Description	Default
$K$	FL⁻²(LM^−1/3)^1+A	Charge constant	None
$k$	T/(M $^{\frac{1 - B}{3}}$ L^B)	Charge constant	None
$A$	Dimensionless	Similitude spatial exponent	None
$B$	Dimensionless	Similitude temporal exponent	None
$K_{c}$	F/L²	Charge constant	None
$γ$	Dimensionless	Ratio of specific heats for explosion gas	None
$ρ_{c}$	M/L³	Charge material density	None
$m_{c}$	M	Mass of charge	None
$d_{I}$	L	Initial charge depth	None
$n_{X}$	Dimensionless	X-direction cosine of the free surface normal	None
$n_{Y}$	Dimensionless	Y-direction cosine of the free surface normal	None
$n_{Z}$	Dimensionless	Z-direction cosine of the free surface normal	None
$g$	L/T²	Acceleration due to gravity	None
$p_{a t m}$	F/L²	Atmospheric pressure at free surface	None
$η$	Dimensionless	Wave effect parameter	1.0
$C_{D}$	Dimensionless	Bubble drag coefficient	0.0
$E_{D}$	Dimensionless	Bubble drag exponent	2.0
$T_{f i n a l}$	T	Maximum allowable time in bubble simulation	None
$N_{s t e p s}$	Dimensionless	Maximum allowable number of steps in bubble simulation	1500
$Ω_{r e l}$	Dimensionless	Relative error tolerance parameter for bubble simulation	1 × 10⁻¹¹
$X_{a b s}$	Dimensionless	Absolute error tolerance parameter for bubble simulation	1 × 10⁻¹¹
$β$	Dimensionless	Error control exponent for bubble simulation	0.2
$ρ_{f}$	M/L³	Fluid mass density	None
$c_{f}$	L/T	Fluid speed of sound	None

All of the parameters specified affect only the bubble amplitude; other physical parameters in the problem are independent. You can suppress the effects of wave loss in the bubble dynamics and introduce empirical flow drag, if desired. Detailed information about the bubble mechanical model is given in Loading due to an incident dilatational wave field.

In an underwater explosion event a bubble migrates upward toward, and possibly reaches, the free water surface. If the bubble migration reaches the free water surface during the specified analysis time, Abaqus applies loads of zero magnitude after this point.

Model data about the bubble simulation are written to the data (.dat) file. During an Abaqus/Standard analysis history data are written each increment to the output database (.odb) file. The history data include the radius of the bubble and the bubble depth below the free water surface. For reference, the pressure and acoustic load quantities at the standoff point are also written to the data file; these load terms include the direct plane-wave term and the spherical spreading (“afterflow”) effect (see Loading due to an incident dilatational wave field).

For the preferred interface the loading effects due to bubble formation can be defined for spherical incident wave loading using the UNDEX charge property definition. Because the bubble simulation uses spherical symmetry, the incident wave interaction property must define a spherical wave.

Input File Usage

Use the following options to specify loading effects due to bubble formation using the UNDEX charge property definition:

INCIDENT WAVE INTERACTION PROPERTY, 
NAME=wave property name, TYPE=SPHERE
UNDEX CHARGE PROPERTY
data defining the UNDEX charge
INCIDENT WAVE INTERACTION, PROPERTY=wave property name,
 UNDEX
fluid surface name, source node, standoff node, reference magnitude

Abaqus/CAE Usage

Use the following input to specify loading effects due to bubble formation using the UNDEX charge property definition:

Interaction module: Create Interaction Property: Name: wave property name and Incident wave: Definition: Spherical, Propagation model: UNDEX charge, enter data defining the UNDEX charge
Create Interaction: Incident wave: Definition: UNDEX, Wave property: wave property name, enter data defining the UNDEX charge

Use the following input to specify pressure at the standoff point using tabulated data:

Load or Interaction module: Create Amplitude: Name: pressure 
and select Tabular
Interaction module: Create Interaction: Incident wave: select the standoff point: Definition: Pressure, Pressure amplitude: pressure

Use the following input to specify source node location time histories using tabulated data:

Load or Interaction module: Create Amplitude: Name: name 
and select Tabular
Load module: Create Boundary Condition: select step: Displacement/Rotation or Velocity/Angular velocity: select the source node as the region and toggle on the degree or degrees of freedom, Amplitude: name

Modeling Incident Wave Loading on a Moving Structure

To model the effect of relative motion between a structure (such as a ship) and the wave source during the analysis using the preferred interface, the source node can be assigned a velocity. It is assumed that the entire fluid-solid model is moving at a velocity with respect to the source node during the loading and that the speed of the model's motion is low compared to the speed of propagation of the incident wave. That is, the effect of the speed of the source is neglected in the computation of the loads, but the change in position of the source is included. This is equivalent to assuming that the relative motion between the source and the model is at a low Mach number. Relative motion can be specified only for transient analyses.

In addition to prescribing boundary conditions at the source node, a small mass element must be defined at the source node.

Input File Usage

Use the following option to assign a velocity to the source node:

BOUNDARY, TYPE=DISPLACEMENT or VELOCITY,  AMPLITUDE=name
source node, degrees of freedom

Abaqus/CAE Usage

Load module: Create Boundary Condition: select step: Velocity/Angular velocity or Displacement/Rotation: select regions and toggle on the degree or degrees of freedom, Amplitude: name

Specifying the Reflection Effects

The waves emanating from the source might reflect off plane surfaces, such as seabeds or sea surfaces, before reaching the specified standoff point. Thus, the incident wave loading consists of the waves arriving from a direct path from the source, as well as those arriving from reflections off the planes. In Abaqus an arbitrary number of these planes can be defined, each with its own location, orientation, and reflection coefficient.

If no reflection coefficient is specified, the plane is assumed to be nonreflective; a zero reflected pressure is applied. If a reflection coefficient is specified, the magnitude of the reflected waves are modified by the reflection coefficient $Q$ according to the formula:

$p_{r e f l e c t e d} = Q p_{i n c i d e n t} .$

Only real values for $Q$ are used.

The reflection planes are allowed only for incident waves that are defined in terms of fluid pressure values. Only one reflection off each plane is considered. If the effect of many successive reflections is important, these surfaces should be part of the finite element model. Reflection planes should not be used at a boundary of the finite element model if the total wave formulation is used, since in that case the incident wave will be reflected automatically by that boundary.

Input File Usage

Use the following option in conjunction with the INCIDENT WAVE INTERACTION option to define an incident wave reflection plane:

INCIDENT WAVE REFLECTION

Abaqus/CAE Usage

Incident wave reflections are not supported in Abaqus/CAE.

Boundary with Prescribed Pressure

The acoustic pressure degree of freedom at nodes of acoustic elements can be prescribed using a boundary condition. However, since you can use the nodal acoustic pressure in an Abaqus analysis to refer to the total pressure at that point or to only the scattered component, care must be exercised in some circumstances.

When the total wave formulation is used, a boundary condition alone is sufficient to specify a prescribed total dynamic pressure on a boundary.

In an analysis without incident wave loading, the nodal degree of freedom is generally equal to the total acoustic pressure at that point. Therefore, its value can be prescribed using a boundary condition in a manner consistent with other boundary conditions in Abaqus. For example, you can set the acoustic pressure at all of the nodes at a duct inlet to a prescribed amplitude to analyze the propagation of waves along the duct. The free surface of a body of water can be modeled by setting the acoustic pressure to zero at the surface.

When incident wave loading is used, the scattered wave formulation defines the nodal acoustic degree of freedom to be equal to the scattered pressure. Consequently, a boundary condition definition for this degree of freedom affects the scattered pressure only. The total acoustic pressure at a node is not directly accessible in this formulation. Specification of the total pressure in a scattered formulation analysis is nevertheless required in some instances (for example, when modeling a free surface of a body of water). In this case, one of the following methods should be used.

If the fluid surface with prescribed total pressure is planar, unbroken, and of infinite extent, an incident wave reflection plane and a boundary condition can be used together to model the fact that the total pressure is zero on the free surface. A “soft” incident wave reflection plane coincident with the free surface will make sure that the structure is subjected to the incident wave load reflected off the free surface. A boundary condition setting the acoustic pressure in the surface equal to zero will make sure that any scattered waves emitted by the structure are reflected properly. The scattered wave solution in the fluid must be interpreted taking into consideration the fact that the incident field now includes a reflection of the source as well. If the fluid surface with prescribed total pressure is planar but broken by an object, such as a floating ship, this modeling technique might still be applied. However, the reflected loads due to the incident wave are computed as if the reflection plane passes through the hull of the ship; this approximation neglects some diffraction effects and may or may not be applicable in all situations of interest.

Alternatively, the free surface condition of the fluid can be eliminated by modeling the top layer of the fluid using structural elements, such as membrane elements, instead of acoustic elements. The “structural fluid” surface and the “acoustic fluid” surface are then coupled using either a surface-based mesh tie constraint (Mesh Tie Constraints) or, in Abaqus/Standard, acoustic-structural interface elements; and the incident wave loading must be applied on both the “structural fluid” and the “acoustic fluid” surfaces. The material properties of the “structural fluid” elements should be similar to those of the adjacent acoustic fluid. In Abaqus/Explicit the thickness of the “structural fluid” elements must be such that the masses at nodes on either side of the coupling constraint are nearly equal. This modeling technique allows the geometry of the surface on which total pressure is to be prescribed to depart from an unbroken, infinite plane. As a secondary benefit of this technique, you can obtain the velocity profile on the free surface since the displacement degrees of freedom are now activated at the “structural fluid” nodes. If a nonzero pressure boundary condition is desired, it can be applied as a distributed loading on the other side of the “structural fluid” elements.

Input File Usage

Use the following options for the first modeling technique with the default scattered wave formulation:

BOUNDARY
INCIDENT WAVE REFLECTION

Use the following option for the second modeling technique with the default scattered wave formulation:

TIE
INCIDENT WAVE INTERACTION

Use the following option with the total wave formulation:

BOUNDARY

Abaqus/CAE Usage

Load module: Create BC: choose Other for the Category and Acoustic pressure for the Types for Selected Step

Defining Air Blast Loading for Incident Shock Waves Using the CONWEP Model in Abaqus/Explicit

An explosion in air forms a highly compressed gas mass that interacts with the surrounding air, generating an outward-propagating shock wave. The loading effects due to an explosion in air can be defined, for spherical incident waves (air blast) or hemispherical incident waves (surface blast), by empirical data provided by the CONWEP model in conjunction with the incident wave loading definition.

Unlike an acoustic wave, a blast wave corresponds to a shock wave with discontinuities in pressure, density, etc. across the wave front. Figure 3 shows a typical pressure history of a blast wave.

The CONWEP model uses a scaled distance based on the distance of the loading surface from the source of the explosion and the amount of explosive detonated. For a given scaled distance, the model provides the following empirical data: the maximum overpressure (above atmospheric), the arrival time, the positive phase duration, and the exponential decay coefficient for both the incident pressure and the reflected pressure. Using these parameters, the entire time history of both the incident pressure and reflected pressure as shown in Figure 3 can be constructed. Use of a standoff point is not required.

The total pressure, $P (t)$ , on a surface due to the blast wave is a function of the incident pressure, $P_{i n c i d e n t} (t)$ , the reflected pressure, $P_{r e f l e c t} (t)$ , and the angle of incidence, $θ$ , which is defined as the angle between the normal of the loading surface and the vector that points from the surface to the explosion source. The total pressure is defined as

$P (t) = P_{i n c i d e n t} (t) [1 + \cos θ - 2 \cos^{2} θ] + P_{r e f l e c t} (t) \cos^{2} θ f o r \cos θ \geq 0;$

$P (t) = P_{i n c i d e n t} (t) f o r \cos θ < 0.$

The air blast loading due to the total pressure can be scaled using a magnitude scale factor.

A detonation time can be specified if the explosion does not occur at the start of the analysis. The detonation time needs to be given in total time; see Conventions for a description of the time convention. The arrival time at a location is defined as the elapsed time for the wave to arrive at that location after detonation.

The CONWEP empirical data are given in a specific set of units, which must be converted to the units used in the analysis. You will need to specify multiplying factors for conversion of these units to SI units. For the specification of the mass of the explosive in TNT equivalence, you can choose any convenient mass unit, which can be different from the mass unit used in the analysis. For computation of the pressure loading, you will need to specify multiplying factors for conversion of length, time, and pressure units used in the analysis to SI units. Some typical conversion multiplier values are given in Table 3.

Table 3. Multipliers used in conjunction with the CONWEP model for conversion to SI units.
Quantity	Unit	SI Unit	Multiplier for conversion to SI
Mass	ton	kg	1000
Mass	lb	kg	0.45359
Length	mm	m	0.001
Length	ft	m	0.3048
Time	msec	sec	0.001
Pressure	MPa	Pa	10⁶
Pressure	psi	Pa	6894.8
Pressure	psf	Pa	47.88

For any given amount of explosive, the CONWEP empirical data are valid only within a range of distances from the source. The minimum distance at which the data are valid corresponds to the charge radius. Thus, the analysis terminates if the distance of any part of the loading surface from the source is less than the charge radius. For distances that are larger than the maximum valid range, linear extrapolation is used up to an extended maximum range where the reflected pressure decreases to zero. No loading is applied beyond the extended maximum range.

The CONWEP empirical data do not account for shadowing by intervening objects or for any effects due to confinement. In the definition of incident wave interaction using the CONWEP model, you cannot use incident wave reflection.

The CONWEP pressure load can be requested as element face variable output to the output database file (see Abaqus/Explicit Output Variable Identifiers).

Input File Usage

Use the following options to specify loading effects due to explosion in air using the CONWEP charge property definition:

INCIDENT WAVE INTERACTION PROPERTY,
NAME=wave property name, TYPE=AIR BLAST or SURFACE BLAST
CONWEP CHARGE PROPERTY
data defining the CONWEP charge
INCIDENT WAVE INTERACTION, PROPERTY=wave property name,
CONWEP
loading surface name, source node,  detonation time, magnitude scale factor

Abaqus/CAE Usage

Use the following options to specify loading effects due to explosion in air using the CONWEP charge property definition:

Interaction module: Create Interaction Property: Name: wave property name and Incident wave: Definition: Air blast or Surface blast: enter data defining the CONWEP charge

Interaction module: Create Interaction: Name: incident wave name and Incident wave: select the source point: CONWEP (Air/Surface blast): select the region: CONWEP Data: enter data defining the time of detonation and magnitude scale factor

Modifying or Removing Incident Wave Loads

Only the incident wave loads that are specified in a particular step are applied in that step; previous definitions are removed automatically. Consequently, incident wave loads that are active during two subsequent steps should be specified in each step. This is akin to the behavior that can be specified for other types of loads by releasing any load of that type in a step (see About Loads).

Alternative Incident Wave Loading Interface

In general, the concepts of the alternative incident wave loading interface are the same as the preferred interface; however, the syntax for specifying the incident wave loading is different. The preferred incident wave loading interface is supported in Abaqus/CAE. The alternative interface is not supported in Abaqus/CAE. For conceptual information, see Incident Wave Loading due to External Sources.

Prescribing the Geometric Properties and the Speed of the Incident Wave (Alternative Interface)

Conceptually, the alternative interface is the same as the preferred interface; however, the usages are different. For conceptual information, see Prescribing Geometric Properties and the Speed of the Incident Wave.

Input File Usage

INCIDENT WAVE PROPERTY, NAME=wave property name,
 TYPE=PLANE or SPHERE
data lines to specify the location of the acoustic source and the standoff point
INCIDENT WAVE FLUID PROPERTY
bulk modulus, mass density
INCIDENT WAVE, PROPERTY=wave property name

Abaqus/CAE Usage

The alternative incident wave loading interface is not supported in Abaqus/CAE.

Defining the Time History of the Source Pulse (Alternative Interface)

Conceptually, the alternative interface is the same as the preferred interface; however, the usages are different. For conceptual information, see Defining the Amplitude of the Source Pulse.

Input File Usage

Use the following option to define the time history in terms of fluid pressure values:

INCIDENT WAVE, PRESSURE AMPLITUDE=amplitude data table name
solid or fluid surface name, reference magnitude

Use the following option to define the time history in terms of fluid particle acceleration values:

INCIDENT WAVE, ACCELERATION AMPLITUDE=amplitude data table 
name
fluid surface name, reference magnitude

Abaqus/CAE Usage

The alternative incident wave loading interface is not supported in Abaqus/CAE.

Defining Bubble Loading for Spherical Incident Wave Loading (Alternative Interface)

Conceptually, the alternative interface is the same as the preferred interface; however, the usages are different. For conceptual information, see Defining Bubble Loading for Spherical Incident Wave Loading.

To define the bubble dynamics using a model internal to Abaqus, you can specify a bubble amplitude. Use of the bubble loading amplitude is generally similar to the use of any other amplitude in Abaqus.

Input File Usage

Use the following options:

AMPLITUDE, DEFINITION=BUBBLE, NAME=name
INCIDENT WAVE PROPERTY, TYPE=SPHERE, 
NAME=wave property name
INCIDENT WAVE, PRESSURE AMPLITUDE=name
solid or fluid surface name, reference magnitude

Abaqus/CAE Usage

The alternative incident wave loading interface is not supported in Abaqus/CAE.

Specifying the Reflection Effects (Alternative Interface)

Conceptually, the alternative interface is the same as the preferred interface; however, the usages are different. For conceptual information, see Specifying the Reflection Effects.

Input File Usage

Use the following option in conjunction with the INCIDENT WAVE option to define an incident wave reflection plane:

INCIDENT WAVE REFLECTION

Abaqus/CAE Usage

The alternative incident wave loading interface is not supported in Abaqus/CAE.

Modeling Incident Wave Loading on a Moving Structure (Alternative Interface)

To model the effect of rigid motion of a structure such as a ship during the incident wave loading history, the standoff point can have a specified velocity. It is assumed that the entire fluid-solid model is moving at this velocity with respect to the source point during the loading and that the speed of the model's motion is low compared to the speed of propagation of the incident wave.

Input File Usage

INCIDENT WAVE PROPERTY, NAME=wave property name
data line to specify the velocity of the standoff point

Abaqus/CAE Usage

The alternative incident wave loading interface is not supported in Abaqus/CAE.

Example: Submarine Close to the Free Surface

The problem shown in Figure 4 has the following features: a free surface $A_{0}$ , seabed $A_{s b}$ as a reflection plane, a wet solid surface $A_{s w}$ , the fluid surface $A_{f w}$ that is tied to the solid surface $A_{s w}$ , and the boundary $A_{inf}$ of the finite modeled domain separating the infinite acoustic medium. The source S of the underwater explosion loading is also shown.

Scattered Wave Solution

Here the scattered wave response in the acoustic medium is of interest along with that of the structure to the incident wave loading. Cavitation in the fluid is not considered in a scattered wave formulation. Similarly, the initial hydrostatic pressure in the fluid is not modeled.

The zero dynamic acoustic pressure boundary condition on the free surface requires both a “soft” reflection plane coinciding with the free surface $A_{0}$ and a zero scattered pressure boundary condition at the nodes on this free surface. The incident wave loading is applied on the fluid surface, $A_{f w}$ , and on the wet solid surface, $A_{s w}$ . The incident wave loading can be only of pressure amplitude type since the loading includes a solid surface.

A good location for the standoff node is marked as A in Figure 4. This node is in the fluid, close to the structure, and closer to incident wave source S than any portion of the seabed or the free surface. The standoff node's offset from the loaded surfaces is exaggerated for emphasis in the figure.

The radiation condition is specified on the acoustic surface $A_{inf}$ such that the scattered wave impinging on this boundary with the infinite medium does not reflect back into the computational domain. The seabed is modeled with an incident wave reflection plane on surface $A_{s b}$ . The reflection loss at this seabed surface is modeled using an impedance property.

If the response of the structure in the nonlinear regime is of interest, the initial stress state in the structure should be established using Abaqus/Standard in a static analysis. The stress state in the structure is then imported into Abaqus/Explicit, and the loading on the solid surfaces causing the initial stress state is respecified in the acoustic analysis.

The following template schematically shows some of the Abaqus input file options that are used to solve this problem using the scattered wave formulation:

HEADING
…
SURFACE, NAME= $A_{f w}$  
Data lines to define the acoustic surface that is wetting the solid
SURFACE, NAME= $A_{s w}$  
Data lines to define the solid surface that is wetted by the fluid
SURFACE, NAME= $A_{inf}$  
Data lines to define the acoustic surface separating the modeled region from the infinite medium
INCIDENT WAVE INTERACTION PROPERTY, NAME=IWPROP
AMPLITUDE, DEFINITION=TABULAR, NAME=PRESSUREVTIME
TIE, NAME=COUPLING
 $A_{f w}$ ,  $A_{s w}$  
STEP
** For an Abaqus/Standard analysis:
DYNAMIC
** For an Abaqus/Explicit analysis:
DYNAMIC, EXPLICIT
** Load the acoustic surface
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME,
PROPERTY=IWPROP
 $A_{f w}$ , source node, standoff node, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q 
INCIDENT WAVE REFLECTION
Data lines for a "soft" reflection plane over the free surface  $A_{0}$ .
** Load the solid surface
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME,
PROPERTY=IWPROP
 $A_{s w}$ , source node, standoff node, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ ,  seabed_Q 
INCIDENT WAVE REFLECTION
Data lines for a "soft" reflection plane over the free surface  $A_{0}$ .
BOUNDARY
** zero pressure boundary condition on the free surface
Set of nodes on the free surface  $A_{0}$ , 8, 8, 0.0
SIMPEDANCE
 $A_{inf}$ , 
END STEP

Total Wave Solution

Here, the total wave response in the acoustic medium is of interest along with that of the structure to the incident wave loading. Cavitation in the fluid might be included. Similarly, a linearly varying initial hydrostatic pressure in the fluid can be specified.

The zero dynamic acoustic pressure boundary condition on the free surfaces requires only a zero pressure boundary condition at the nodes on this free surface. A reflection plane should not be included along the free surface. The incident wave loading is applied only on the fluid surface, $A_{inf}$ , that separates the modeled region from the surrounding infinite acoustic medium. No incident wave should be applied directly on the structure surfaces. If the incident wave is considered planar, an acceleration-type amplitude can be used with the incident wave loading. Otherwise, a pressure-type amplitude must be used with the incident wave loading.

An ideal location for the standoff node depends on the type of amplitude used for the time history of the incident wave loading. The location A shown in Figure 4 can be used if the incident wave loading time history is of pressure amplitude type. Otherwise, the location B that is just on the boundary $A_{inf}$ and closer to the source S than any part of either the seabed or the free surface can be used.

The nonreflecting impedance condition is specified on the acoustic surface, $A_{inf}$ , such that the scattered part of the total wave impinging on this boundary with the infinite medium does not reflect back into the computational domain. The seabed is modeled with an incident wave reflection plane on the surface $A_{s b}$ .

The following template schematically shows some of the input file options that are used to solve this problem using the total wave formulation:

HEADING
…
ACOUSTIC WAVE FORMULATION, TYPE=TOTAL WAVE
MATERIAL, NAME=CAVITATING_FLUID
ACOUSTIC MEDIUM, BULK MODULUS
Data lines to define the fluid bulk modulus
ACOUSTIC MEDIUM, CAVITATION LIMIT
Data lines to define the fluid cavitation limit
…
SURFACE, NAME= $A_{f w}$  
Data lines to define the acoustic surface that is wetting the solid
SURFACE, NAME= $A_{s w}$  
Data lines to define the solid surface that is wetted by the fluid
SURFACE, NAME= $A_{inf}$  
Data lines to define the acoustic surface separating the modeled region from the infinite medium
INCIDENT WAVE INTERACTION PROPERTY, NAME=IWPROP
AMPLITUDE, DEFINITION=TABULAR, NAME=PRESSUREVTIME
Data lines to define the pressure-time history at the standoff point
TIE, NAME=COUPLING
 $A_{f w}$ ,  $A_{s w}$  
INITIAL CONDITIONS, TYPE=ACOUSTIC STATIC PRESSURE
Data lines to define the initial linear hydrostatic pressure in the fluid
STEP
DYNAMIC, EXPLICIT
** Load the acoustic surface
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME, 
PROPERTY=IWPROP
 $A_{inf}$ , source node, standoff node, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q 
BOUNDARY
** zero pressure boundary condition on the free surface
Set of nodes on the free surface  $A_{0}$ , 8, 8, 0.0
SIMPEDANCE
 $A_{inf}$ , 
END STEP

Example: Submarine in Deep Water

This problem is similar to the previous example of a submarine close to the free surface except for the following differences. There is no free surface in this problem; and the fluid surface, $A_{inf}$ , and the fluid medium completely enclose the structure. If the structure is sufficiently deep in the water, hydrostatic pressure may be considered uniform instead of varying linearly with depth. Under this assumption, the initial stress state in the structure can be established with a uniform pressure loading all around it, if desired. In addition, if the structure is sufficiently deep in the water, the hydrostatic pressure may be significant compared to the incident wave loading; hence, the cavitation in the fluid may not be of concern.

Example: Surface Ship

Here the effect of underwater explosion loading on a surface ship is of interest (see Figure 5).

This problem is similar to the previous example of a submarine close to the free surface except for the following differences. The free surface of fluid is not continuous, and a part of the structure is exposed to the atmosphere. A soft reflection plane coinciding with the free surface is not used in this problem as in the submarine problems under the scattered wave formulation. To be able to use the scattered wave formulation in this case, the modeling technique is used in which the free surface is replaced with “structural fluid” elements. A layer of fluid at the free surface is modeled using non-acoustic elements such as membrane elements. These elements are coupled to the underlying acoustic fluid using a mesh tie constraint. The non-acoustic elements have properties similar to the fluid itself since these elements are replacing the fluid medium near the free surface and should have a thickness similar to the height of the adjacent acoustic elements. Incident wave loading with the scattered wave formulation must now be applied on these newly created surfaces as well. This technique has the added advantage of providing the deformed shape of the free surface under the loading.

The following template shows some of the Abaqus input file options used for this case:

HEADING
…
SURFACE, NAME=A01_structuralfluid
Data lines to define the "structural fluid" surface 
SURFACE, NAME=A01_acousticfluid
Data lines to define the adjacent acoustic fluid surface 
SURFACE, NAME=A02_structuralfluid
Data lines to define the "structural fluid" surface 
SURFACE, NAME=A02_acousticfluid
Data lines to define the adjacent acoustic fluid surface 
SURFACE, NAME=Asw_solid 
Data lines to define the actual solid surface that is wetted by the fluid
SURFACE, NAME=Asw_fluid 
Data lines to define the actual acoustic surface that is adjacent to the structure
SURFACE, NAME= $A_{inf}$  
Data lines to define the acoustic surface separating the modeled region from the infinite medium
INCIDENT WAVE INTERACTION PROPERTY, NAME=IWPROP
AMPLITUDE, DEFINITION=TABULAR, NAME=PRESSUREVTIME
Data lines to define the pressure-time history at the standoff point
TIE, NAME=COUPLING
Asw_fluid, Asw_solid
A01_acousticfluid, A01_structuralfluid
A02_acousticfluid, A02_structuralfluid 
STEP
** For an Abaqus/Standard analysis:
DYNAMIC
** For an Abaqus/Explicit analysis:
DYNAMIC, EXPLICIT
** Load the acoustic surfaces
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME, 
PROPERTY=IWPROP
A01_acousticfluid, source point, standoff point, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME,
PROPERTY=IWPROP
A02_acousticfluid, source point, standoff point, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME, 
PROPERTY=IWPROP
Asw_fluid, source point, standoff point, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q
** Load the solid surfaces
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME, 
PROPERTY=IWPROP
A01_structuralfluid, source point, standoff point, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME, 
PROPERTY=IWPROP
A02_structuralfluid, source point, standoff point, reference magnitude
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q
INCIDENT WAVE INTERACTION, PRESSURE AMPLITUDE=PRESSUREVTIME, 
PROPERTY=IWPROP
Asw_solid, source point, standoff point, reference magnitude 
INCIDENT WAVE REFLECTION
Data lines for the reflection plane over the seabed  $A_{s b}$ , seabed_Q 
SIMPEDANCE
 $A_{inf}$ , 
END STEP

Compared to the total wave formulation analysis of a submarine close to the free surface, the following differences are noteworthy. As shown in Figure 5, the free surface with zero dynamic pressure boundary condition is now split into two parts: $A_{01}$ and $A_{02}$ . The fluid surface wetting the ship ( $A_{f w}$ ) and the wetted ship surface ( $A_{s w}$ ), which are tied together, do not encircle the whole structure. Besides these differences, the modeling considerations for the surface ship problem are similar to the total wave analysis of the submarine near the free surface.

Example: Airblast Loading on a Structure

Here the effect of airblast (explosion in the air) loading on a structure is of interest (see Figure 6).

Since the stiffness and inertia of the air medium are negligible, the acoustic medium is not modeled. Rather the incident wave loading is applied directly on the structure itself. The solid surface $A_{s w}$ where the incident wave loading is applied is shown in Figure 6. Since the acoustic medium is not modeled, the total wave and the scattered wave formulations are identical.

Example: Fluid Cavitation without Incident Wave Loading

You may be interested in modeling acoustic problems in Abaqus/Explicit where the loading is applied through either prescribed pressure boundaries or specified pressure-conjugate concentrated loads. Choice of the scattered or the total wave formulation is not relevant in these problems even when the acoustic medium is capable of cavitation.

Acoustic and Shock Loads

Specified Boundary Impedance

Sloshing of a Free Surface

Acoustic-Structural Interface

Steady-State Dynamics

Specifying Impedance Conditions

Specifying Surface-Based Impedance Conditions

Specifying Element-Based Impedance Conditions

Modifying or Removing Impedance Conditions

Radiation Boundaries for Exterior Problems

Planar Nonreflecting Boundary Condition

Improved Nonreflecting Boundary Condition for Plane Waves

Geometry-Based Nonreflecting Boundary Conditions

Combining Different Radiation Conditions in the Same Problem

Concentrated Pressure-Conjugate Load

Incident Wave Loading due to External Sources

Scattered and Total Wave Formulations

Scattered Wave Formulation

Total Wave Formulation

Initialization of Acoustic Fields

Describing Incident Wave Loading

Prescribing Geometric Properties and the Speed of the Incident Wave

Identifying the Fluid and the Solid Surfaces for Incident Wave Loading

The Standoff Point

Defining the Amplitude of the Source Pulse

Defining Bubble Loading for Spherical Incident Wave Loading

Modeling Incident Wave Loading on a Moving Structure

Specifying the Reflection Effects

Boundary with Prescribed Pressure

Defining Air Blast Loading for Incident Shock Waves Using the CONWEP Model in Abaqus/Explicit

Modifying or Removing Incident Wave Loads

Alternative Incident Wave Loading Interface

Prescribing the Geometric Properties and the Speed of the Incident Wave (Alternative Interface)

Defining the Time History of the Source Pulse (Alternative Interface)

Defining Bubble Loading for Spherical Incident Wave Loading (Alternative Interface)

Specifying the Reflection Effects (Alternative Interface)

Modeling Incident Wave Loading on a Moving Structure (Alternative Interface)

Example: Submarine Close to the Free Surface

Scattered Wave Solution

Total Wave Solution

Example: Submarine in Deep Water

Example: Surface Ship

Example: Airblast Loading on a Structure

Example: Fluid Cavitation without Incident Wave Loading