*CONTACT CONTROLS ASSIGNMENT

Assign contact controls for the general contact algorithm.

This option is used to modify contact controls for specific contact interactions within the domain considered by the general contact algorithm in Abaqus/Explicit and Abaqus/Standard. It must be used in conjunction with the CONTACT option.

This page discusses:

See Also
*CONTACT
In Other Guides
Generally Applicable Contact Controls in Abaqus/Standard
Contact Controls for General Contact in Abaqus/Explicit
Contact Constraint Enforcement Methods in Abaqus/Standard
Frictional Behavior
Pore Fluid Contact Properties
About General Contact in Abaqus/Explicit

Products Abaqus/Standard Abaqus/Explicit

Type Model or history data

LevelModelStep

Required, mutually exclusive parameters

AUTOMATIC OVERCLOSURE RESOLUTION

This parameter applies only to Abaqus/Explicit analyses.

Include this parameter to store offsets instead of adjusting nodes during initial overclosure resolution between surface pairs in the general contact domain as specified in the data lines.

BEAM CROSS SECTION

By default, contact calculations for noncircular beams are based on the internally generated surface-element representation of their cross-sections. For circular beams and pipes, the contact calculations use contact edges and nodes with a radius equal to the section radius.

Set BEAM CROSS SECTION=EXACT to activate contact calculations based on the internally generated surface-element representation of the beam cross-sections for the entire model.

Set BEAM CROSS SECTION=CIRCUMSCRIBED CIRCLE to activate contact calculations based on the circumscribed circle representation of the beam cross-sections for the entire model.

CONTACT THICKNESS REDUCTION

This parameter applies only to Abaqus/Explicit analyses.

Set CONTACT THICKNESS REDUCTION=SELF to limit automatic contact thickness reductions to only regions of potential self-contact and the perimeters of shell surfaces for the entire model.

Set CONTACT THICKNESS REDUCTION=NOPERIMSELF to limit automatic contact thickness reductions to only regions of potential self-contact for the entire model.

NODAL EROSION

This parameter applies only to Abaqus/Explicit analyses.

Set NODAL EROSION=NO (default) to keep a node of an element-based surface in the general contact domain as a point mass after all contact faces and edges to which it is attached have eroded.

Set NODAL EROSION=YES to delete a node of an element-based surface from the general contact domain once all contact faces and edges to which it is attached have eroded.

NORMAL EVOLUTION

This parameter applies only to Abaqus/Explicit analyses with cohesive contact behavior.

Set NORMAL EVOLUTION=MAIN (default) to have the contact normal direction evolve with the main surface normal direction.

Set NORMAL EVOLUTION=AVERAGE to have the contact normal direction evolve with the average evolution of the main and the secondary surface normal directions.

ROTATIONAL TERMS

This parameter applies only to Abaqus/Explicit analyses.

Set ROTATIONAL TERMS=NONE (default) to ignore the effects of shell and beam thickness offsets for contact.

Set ROTATIONAL TERMS=STRUCTURAL to account for the effects of shell and beam thickness offsets for contact.

SHELL REPRESENTATION

This parameter applies only to general contact in Abaqus/Standard analyses.

Set SHELL REPRESENTATION=REFERENCE SURFACE (default) to represent shells in general contact by the shell reference surface.

Set SHELL REPRESENTATION=EXTRA PERIMETER FACES to represent shell perimeter regions in general contact with internally generated surface elements near the exterior of the shell, with nonperimeter regions represented by the shell reference surface.

THREAD MESH GENERATION

This parameter applies only to general contact in Abaqus/Standard analyses.

Include this parameter to activate the surface element representations of the external and internal threads.

TYPE

Set TYPE=ENFORCEMENT METHOD to assign the numerical enforcement method of the contact constraints. This option applies only to Abaqus/Standard analyses. It cannot be used in conjunction with the SURFACE BEHAVIOR, DIRECT; SURFACE BEHAVIOR, AUGMENTED LAGRANGE; or SURFACE BEHAVIOR, PENALTY options.

Set TYPE=FOLD INVERSION CHECK to activate the fold inversion check.

Set TYPE=FRICTION ENFORCEMENT to assign the numerical friction enforcement of the "stick" condition of contact constraints. This option applies only to Abaqus/Standard analyses. It cannot be used in conjunction with the FRICTION, SLIP TOLERANCE; FRICTION, ELASTIC SLIP; or FRICTION, LAGRANGE options.

Set TYPE=PERMEABILITY CONSTRAINT METHOD to assign the contact permeability constraint method. This option applies only to Abaqus/Standard analyses. It cannot be used in conjunction with the CONTACT PERMEABILITY, CONSTRAINT METHOD option.

Set TYPE=SCALE PENALTY to assign a scale factor to the default penalty stiffnesses. This option applies only to Abaqus/Explicit analyses.

Set TYPE=TRACKING THICKNESS to assign a thickness that determines the contact tracking distance. It cannot be used in conjunction with the SURFACE INTERACTION, TRACKING THICKNESS option.

Optional parameters

SEEDING

This parameter applies only to Abaqus/Explicit analyses. It controls how the contact seeds are created on Lagrangian surfaces during a coupled Eulerian-Lagrangian analysis.

Set SEEDING=GLOBAL (default if adaptive mesh refinement is not activated) to create seeds on Lagrangian surfaces based on the smallest Eulerian element size in the entire Eulerian mesh; the seeding is performed once at the beginning of the analysis.

Set SEEDING=LOCAL to create seeds on Lagrangian surfaces based on the smallest Eulerian element size in the vicinity of the Lagrangian faces; the seeding is performed once for each face, as soon as a nearby Eulerian element is detected.

Set SEEDING=DYNAMIC (default if adaptive mesh refinement is activated) to create seeds on Lagrangian surfaces based on the smallest Eulerian element size in the vicinity of the Lagrangian faces; the seed density is updated during the analysis.

Data lines for AUTOMATIC OVERCLOSURE RESOLUTION

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. The overclosure resolution method. The “words” ADJUST NODES (default) or STORE OFFSETS.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for THREAD MESH GENERATION

First line
  1. The name of the first surface. The surface should be a portion of a cylindrical surface representing either the nominal surface of the externally threaded (bolt or bolt-like) solid part or the nominal surface of the internally threaded (nut or nut-like) solid part.

  2. The name of the second surface. The surface should be a portion of a cylindrical surface representing either the nominal surface of the externally threaded (bolt or bolt-like) solid part or the nominal surface of the internally threaded (nut or nut-like) solid part. If the first surface is on the bolt or bolt-like solid part, the second surface should be on the nut or nut-like solid part and vice versa.

  3. The named threaded interface definition THREADED INTERFACE to be assigned.

Repeat this data line as often as necessary.

Data lines for TYPE=ENFORCEMENT METHOD with direct enforcement specified

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. Specify DIRECT.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for TYPE=ENFORCEMENT METHOD with augmented Lagrange or penalty enforcement specified

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. Specify AUGMENTED LAGRANGE or PENALTY.

  4. User-defined linear penalty stiffness. If this field is left blank or is zero, the linear penalty stiffness is the default value or is multiplied by the scale factor given in the sixth field of the data line.
  5. Clearance at which the contact pressure is zero. The default is zero.
  6. Scale factor for the default linear penalty stiffness or for the linear penalty stiffness if specified in the fourth field of the data line. The default is one.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for TYPE=ENFORCEMENT METHOD with nonlinear penalty enforcement specified

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. Specify NONLINEAR PENALTY.

  4. User-defined final nonlinear penalty stiffness. If this field is left blank or is zero, the final nonlinear penalty stiffness has the default value or is multiplied by the scale factor given in the sixth field of the data line.
  5. Clearance at which the contact pressure is zero. The default is zero.
  6. Scale factor for the default nonlinear penalty stiffness or for the final nonlinear penalty stiffness if specified in the fourth field of the data line. The default is one.
  7. Scale factor for the upper quadratic limit, which is equal to the scale factor times the characteristic contact facet length. The default is 0.03.
  8. The ratio of the initial penalty stiffness over the final penalty stiffness. The default is 0.01.
  9. The ratio that defines the lower quadratic limit. The default is 1/3.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for TYPE=FOLD INVERSION CHECK

First line
  1. The name of the surface for which the fold inversion check should be activated. If the surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

Repeat this data line as often as necessary.

Data lines for TYPE=FRICTION ENFORCEMENT

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. Specify PENALTY or LAGRANGE for penalty or Lagrange multiple enforcement of the "stick" condition, respectively.

  4. Specify SLIP TOLERANCE DISTANCE or UNITLESS SLIP TOLERANCE if the fifth entry of the data line is the slip tolerance distance in units of length or a unitless slip tolerance that will be multiplied by a characteristic length to compute the slip tolerance, respectively. This data line is relevant only for penalty enforcement.

  5. Value associated with the option defined in the fourth data line. This data line is relevant only for penalty enforcement.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for TYPE=PERMEABILITY CONSTRAINT METHOD

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. Specify DIRECT (default) or PENALTY to indicate a direct or numerical approximate enforcement.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for TYPE=SCALE PENALTY

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. The factor by which Abaqus/Explicit will scale the default penalty stiffnesses for the specified contact pairings.

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.

Data lines for TYPE=TRACKING THICKNESS

First line
  1. The name of the first surface. If the first surface name is omitted, a default surface that encompasses the entire general contact domain (including all nodes and facets) is assumed.

  2. The name of the second surface. If the second surface name is omitted or is the same as the first surface name, the specified contact controls are assigned to contact interactions between the first surface and itself.

  3. The value of the tracking thickness

Repeat this data line as often as necessary. If the contact controls assignments overlap, the last assignment applies in the overlap region.