Contact Constraint Enforcement Methods in Abaqus/Standard
Contact constraint enforcement methods in Abaqus/Standard:
are specified as part of the contact controls assignment definition (recommended) or
surface interaction definition;
determine how contact constraints imposed by a physical pressure-overclosure relationship
(see Contact Pressure-Overclosure Relationships) are resolved numerically in an
analysis;
can either strictly enforce or approximate the physical pressure-overclosure
relationships;
can be modified to resolve convergence difficulties due to overconstraints; and
sometimes utilize Lagrange multiplier degrees of freedom.
The available constraint enforcement methods for normal contact in Abaqus/Standard are discussed in detail in this section. The frictional constraint enforcement methods in
Abaqus/Standard are assigned independently of those for the normal contact constraints and are discussed in
Frictional Behavior. The use of Lagrange multipliers in contact
calculations is also covered in this section.
Available Constraint Enforcement Methods in Abaqus/Standard
There are three contact constraint enforcement methods available in Abaqus/Standard:
The direct method attempts to strictly enforce a given pressure-overclosure behavior
per constraint, without approximation or use of augmentation iterations.
The penalty method is a stiff approximation of hard contact.
The augmented Lagrange method uses the same kind of stiff approximation as the penalty
method, but also uses augmentation iterations to improve the accuracy of the
approximation.
The default constraint enforcement method depends on interaction characteristics, as
follows:
The penalty method is used by default for finite-sliding, surface-to-surface contact if
a hard pressure-overclosure relationship is in effect. For general
contact, both the small- and finite-sliding tracking approaches use the penalty method
by default.
The augmented Lagrange method is used by default for three-dimensional self-contact
with node-to-surface discretization if a hard pressure-overclosure
relationship is in effect.
The direct method is the default in all other cases.
You should consider the following factors when choosing the contact enforcement method:
The direct method strictly enforces the specified pressure-overclosure behavior
consistent with the constraint formulation
The penalty or augmented Lagrange constraint enforcement methods sometimes provide more
efficient solutions (generally due to reduced calculation costs per iteration and a
lower number of overall iterations per analysis) at some (typically small) sacrifice in
solution accuracy. See the discussions of the penalty and augmented Lagrange methods
below.
Overconstraints due to overlapping contact definitions or the combination of contact
and other constraint types (see Overconstraint Checks) should be
avoided for directly enforced hard contact.
You can define the enforcement method as follows:
You can define surface pairwise enforcement through contact controls. This method is
recommended.
You can define enforcement through a surface interaction property.
This is the only option available in Abaqus/CAE.
Direct Method
The direct method strictly enforces a given pressure-overclosure behavior for each
constraint, without approximation or use of augmentation iterations.
This method is not supported in Abaqus/CAE. Please refer to the alternative option to use Abaqus/CAE as discussed in Direct Method.
Direct Method for Hard Pressure-Overclosure Behavior
The direct method can be used to strictly enforce a “hard” pressure-overclosure
relationship. Lagrange multipliers are always used in this case.
Direct Method for Softened Pressure-Overclosure Relationships
The direct method is the only method that can be used to enforce “softened”
pressure-overclosure relationships. The direct method can be used to model softened
contact behavior regardless of the type of contact formulation; however, modeling stiff
interface behavior with a contact formulation that is prone to overconstraints can be
difficult. Lagrange multipliers are used if the slope of the pressure-overclosure curve
exceeds 1000 times the underlying element stiffness (as computed by Abaqus/Standard); otherwise, the constraints are enforced without Lagrange multipliers. The usage of
Lagrange multipliers, thus, depends on the contact pressure. Softened pressure-overclosure
relationships are discussed in more detail in Contact Pressure-Overclosure Relationships.
Limitations of the Direct Method
Because of its strict interpretation of contact constraints, hard contact simulations
utilizing the direct enforcement method are susceptible to overconstraint issues. As a
result, directly enforced hard contact is not available for contact pairs defined using
three-dimensional self-contact with node-to-surface discretization. In this instance you
can use an alternate enforcement method or the direct method with a softened
pressure-overclosure relationship.
You might experience similar overconstraint problems with symmetric main-secondary
contact pairs (see Using Symmetric Main-Secondary Contact Pairs to Improve Contact Modeling).
Although directly enforced hard contact is the default for these contact pairs, it is
recommended that you use an alternate enforcement method or a softened contact
relationship.
The penalty method approximates hard pressure-overclosure behavior. With this method the
contact force is proportional to the penetration distance, so some degree of penetration
will occur. Advantages of the penalty method include:
Numerical softening associated with the penalty method can mitigate overconstraint
issues and reduce the number of iterations required in an analysis.
The penalty method can be implemented such that no Lagrange multipliers are used, which
allows for improved solver efficiency.
Choosing a Penalty Method
Abaqus/Standard offers linear and nonlinear variations of the penalty method. With the linear penalty
method the so-called penalty stiffness is constant, so the pressure-overclosure
relationship is linear. With the nonlinear penalty method the penalty stiffness increases
linearly between regions of constant low initial stiffness and constant high final
stiffness, resulting in a nonlinear pressure-overclosure relationship. The default penalty
method is linear.
A comparison of the linear and nonlinear pressure-overclosure relationships with the
default settings is shown in Figure 1.
Figure 1. Comparison of linear and nonlinear pressure-overclosure relationships in a general
analysis with default settings.
Linear Penalty Method
When the linear penalty method is used, Abaqus/Standard will, by default, set the penalty stiffness to 10 times a representative underlying
element stiffness. You can scale or reassign the penalty stiffness, as discussed in
Modifying a Linear Penalty Stiffness below. Contact penetrations resulting from the default penalty stiffness will not
significantly affect the results in most cases; however, these penetrations can
sometimes contribute to some degree of stress inaccuracy (for example, with
displacement-controlled loading and a coarse mesh). The linear penalty method is used by
default for the finite-sliding, surface-to-surface contact formulation. The linear
penalty method is also the default for general contact, irrespective of whether the
small- or finite-sliding tracking approach applies to contact constraints.
Input File Usage
Use both of the following options to specify the linear penalty method:
Defining the linear penalty method through the recommended user interface is not
supported in Abaqus/CAE. Please refer to the alternative option to use Abaqus/CAE as discussed in Linear Penalty Method.
Nonlinear Penalty Method
With the nonlinear penalty method, the pressure-overclosure curve has four distinct
regions shown in Figure 2.
Inactive contact regime: The contact pressure remains zero for clearances greater
than . The default setting of is zero.
Constant initial penalty stiffness regime: The contact pressure varies linearly,
with a slope equal to for penetrations (overclosures) in the range to . The default initial penalty stiffness, , is equal to the representative underlying element stiffness. The
default value of is 1% of a characteristic length computed by Abaqus/Standard to represent a typical facet size.
Stiffening regime: The contact pressure varies quadratically for penetrations in
the range to , while the penalty stiffness increases linearly from to . The default final penalty stiffness, , is equal to 100 times the representative underlying element
stiffness. The default value of is 3% of the same characteristic length used to compute (discussed above).
Constant final penalty stiffness regime: The contact pressure varies linearly, with
a slope equal to for penetrations greater than .
The low initial penalty stiffness typically results in better convergence of the Newton
iterations and better robustness, while the higher final stiffness keeps the overclosure
at an acceptable level as the contact pressure builds up. For linear perturbation
procedures the default penalty stiffness is constant and equal to 100 times the
representative underlying element stiffness, independent of the penalty stiffness used
in the base state. Thus, it is equal to the constant final penalty stiffness.
Input File Usage
Use both of the following options to specify the linear penalty method:
Defining the nonlinear penalty method through the recommended user interface is
not supported in Abaqus/CAE. Please refer to the alternative option to use Abaqus/CAE as discussed in Nonlinear Penalty Method.
Modifying the Penalty Stiffness
If you are interested in investigating the effects of modifying the penalty stiffness, it
is generally recommended that you consider order-of-magnitude changes. Increasing the
penalty stiffness above the threshold value discussed above will, by default, introduce
Lagrange multipliers.
Modifying a Linear Penalty Stiffness
As part of the surface behavior definition, you can specify the linear penalty
stiffness, shift the pressure-overclosure relationship by specifying the clearance at
which the contact pressure is zero, or scale the default or specified penalty stiffness
by a factor.
Input File Usage
To modify the linear penalty behavior in the contact controls assignment
definition:
CONTACT CONTROLS ASSIGNMENT, TYPE=ENFORCEMENT METHODsurface_1, surface_2, PENALTY, penalty stiffness, clearance at zero pressure, factor
Abaqus/CAE Usage
Defining linear penalty behavior through contact controls is not supported in Abaqus/CAE.
Modifying a Nonlinear Penalty Stiffness
As part of the surface behavior definition, you can specify the final nonlinear penalty
stiffness, shift the pressure-overclosure relationship by specifying the clearance at
which the contact pressure is zero, or scale the default or specified penalty stiffness
by a factor. In addition, you can control directly the ratio of the initial to the final
penalty stiffness, the scale factor, and the ratio that determines and .
Input File Usage
To modify the nonlinear penalty behavior in the contact controls assignment
definition:
CONTACT CONTROLS ASSIGNMENT, TYPE=ENFORCEMENT METHODsurface_1, surface_2, NONLINEAR PENALTY, final penalty stiffness, clearance at zero pressure, factor, upper quadratic limit scale factor, ratio of initial penalty stiffness over final penalty stiffness, lower quadratic limit ratio
Abaqus/CAE Usage
Defining nonlinear penalty behavior through contact controls is not supported in
Abaqus/CAE.
Scaling the Penalty Stiffness on a Step-by-Step Basis
You can also scale the penalty stiffness on a step-by-step basis, which will act as an
additional multiplier on any scale factor specified as part of the surface behavior
definition.
Input File Usage
To scale the penalty stiffness on a step-by-step basis:
Adjusting the Penalty Stiffness across Iterations of the First Increment
It is common to have convergence difficulties in the first increment of an analysis if
the contact status changes over a large portion of the contact area upon initial
loading. An approach that tends to improve convergence behavior without sacrificing
accuracy is to use a reduced penalty stiffness in the early iterations of the first
increment and return to the default penalty stiffness for the final iterations of the
first increment and all iterations of subsequent increments. Use of a reduced penalty
stiffness in early iterations helps to robustly find an approximate contact status
distribution, and the goal of later iterations is to then find an accurate solution,
which is reported as the converged solution for the first increment.
Input File Usage
To scale the penalty stiffness within the first increment:
If surface elements have been used to define a contact surface on the exterior of a
substructure (see Contact Modeling If Substructures Are Present), Abaqus/Standard interprets the underlying element stiffness to be zero. This can lead to difficulty in
determining the default penalty stiffness and may cause numerical problems during the
analysis.
Augmented Lagrange Method
The linear penalty method can be used within an augmentation iteration scheme that drives
down the penetration distance. This so-called augmented Lagrange method applies only to hard
pressure-overclosure relationships. The following describes the sequence that occurs in each
increment with this approach:
Abaqus/Standard finds a converged solution with the penalty method.
If a secondary node penetrates the main surface by more than a specified penetration
tolerance, the contact pressure is “augmented” and another series of iterations is
executed until convergence is once again achieved.
Abaqus/Standard continues to augment the contact pressure and find the corresponding converged
solution until the actual penetration is less than the penetration tolerance.
The augmented Lagrange method might require additional iterations in some cases; however,
this approach can make the resolution of contact conditions easier and avoid problems with
overconstraints, while keeping penetrations small. The augmented Lagrange method is used by
default for three-dimensional self-contact using node-to-surface discretization.
The default penetration tolerance is one-tenth of a percent of the characteristic interface
length except in the following cases:
if you specify a penalty stiffness scaling factor, , of less than 1.0 (using the interface discussed below), Abaqus/Standard will automatically scale the default penetration tolerance by a factor of (which will be greater than or equal to 1.0);
the default penetration tolerance for finite-sliding, surface-to-surface contact is
five percent of the characteristic interface length, subject to the scaling discussed in
the previous bullet point.
The default penalty stiffness for the augmented Lagrange method is 1000 times the
representative underlying element stiffness. Lagrange multipliers are used for the augmented
Lagrange method if the penalty stiffness exceeds 1000 times the representative underlying
element stiffness computed by Abaqus/Standard; otherwise, no Lagrange multipliers are used. Therefore, Lagrange multipliers are not
used for the augmented Lagrange method with the default penalty stiffness.
Input File Usage
Use both of the following options to specify the linear penalty method:
Defining the augmented Lagrange method through contact controls is not supported in
Abaqus/CAE.
Modifying the Penetration Tolerance for the Augmented Lagrange Method
You can modify the penetration tolerance for the augmented Lagrange method on a
step-by-step basis by specifying an absolute or relative penetration tolerance. The
relative penetration tolerance is specified with respect to a characteristic length
computed by Abaqus/Standard. The default penetration tolerance was discussed above. The default penetration
tolerance is increased automatically if you set the penalty stiffness scale factor to a
value less than 1.0 (also discussed above); however, Abaqus/Standard will not adjust any directly specified penetration tolerance. Choosing a very small
penetration tolerance might result in an excessive number of augmentation iterations.
Modifying the Penalty Stiffness for the Augmented Lagrange Method
As with the penalty method, you can specify the penalty stiffness, shift the
pressure-overclosure relationship by specifying the clearance at which the contact
pressure is zero, or scale the default or specified penalty stiffness by a factor as part
of the surface behavior definition. You can also scale the penalty stiffness on a
step-by-step basis, which will act as an additional multiplier on any scale factor
specified as part of the surface behavior definition. Choosing a very low penalty
stiffness might result in an excessive number of augmentation iterations.
Input File Usage
To modify the penalty behavior in the contact controls assignment definition:
CONTACT CONTROLS ASSIGNMENT, TYPE=ENFORCEMENT METHODsurface_1, surface_2, AUGMENTED LAGRANGE, penalty stiffness, clearance at zero pressure, factor
Abaqus/CAE Usage
Defining augmented Lagrange behavior through contact controls is not supported in
Abaqus/CAE.
Modifying the Number of Allowed Augmentations for the Augmented Lagrange Method
You can define the number of allowed augmentations for the augmented Lagrange method.
If surface elements have been used to define a contact surface on the exterior of a
substructure (see Contact Modeling If Substructures Are Present), Abaqus/Standard interprets the underlying element stiffness to be zero. This can lead to difficulty in
determining the default penalty stiffness and might cause numerical problems during the
analysis.
Use of Lagrange Multiplier Degrees of Freedom by the Various Methods
Using Lagrange multipliers to enforce contact constraints can add significantly to the
solution cost, but they also protect against numerical errors related to ill-conditioning
that can occur if a high contact stiffness is in effect. Abaqus/Standard automatically chooses whether the constraint method makes use of Lagrange multipliers,
based on a comparison of the contact stiffness to the underlying element stiffness. Table 1 summarizes the use of Lagrange multipliers. Lagrange multipliers are not used for the
default contact stiffnesses associated with the penalty and augmented Lagrange
approximations of hard contact. Any Lagrange multipliers associated with contact are present
only for active contact constraints, so the number of equations might change as the contact
status changes.
Table 1. Use of Lagrange multipliers in constraint enforcement methods.
Constraint Method
Use Lagrange Multipliers
Yes
No1
Direct, hard contact
Always
Never
Direct, exponential softened contact
If
If
Direct, linear softened contact
If
If
Direct, tabular softened contact
If
If
Penalty, hard contact
If
If
Augmented Lagrange, hard contact
If
If
= slope of pressure-overclosure relationship
= penalty stiffness
= underlying element stiffness
1Lagrange
multipliers are always used, regardless of the constraint enforcement method or
stiffness, in the following cases: design sensitivity analyses, direct steady-state
dynamics analyses, analyses using the quasi-Newton method.
Alternative Constraint Enforcement Method
The alternative contact constraint enforcement method applies the enforcement method
through a surface interaction definition. In this case any contact in the model associated
with a particular interaction property will have the specified enforcement method. While
this method is not preferred, it can be useful for cases where the physical contact
properties and the best enforcement method closely align for the same regions of
contact.
Direct Method
The direct method is discussed in more detail in Direct Method.
To modify the nonlinear penalty behavior in the surface behavior definition:
SURFACE BEHAVIOR, PENALTY=NONLINEARfinal penalty stiffness, clearance at zero pressure, factor, upper quadratic limit scale factor, ratio of initial penalty stiffness over final penalty stiffness, lower quadratic limit ratio
Abaqus/CAE Usage
To modify the nonlinear penalty behavior in the surface behavior definition:
Interaction module: contact property editor: MechanicalNormal Behavior: Constraint enforcement method:Penalty (Standard), Behavior:Nonlinear, Maximum stiffness value:Specify:final penalty stiffness, Stiffness scale factor:factor, Initial/Final stiffness ratio:ratio of initial penalty stiffness over final penalty stiffness, Upper quadratic limit scale factor:upper quadratic limit scale factor, Lower quadratic limit ratio:lower quadratic limit ratio, Clearance at which contact pressure is zero:clearance at zero pressure