Products
Abaqus/Standard
Abaqus/Explicit
Abaqus/CAE
Type
Model data
LevelPartPart instanceAssembly
Abaqus/CAE
Element-based surfaces are supported by the Surface toolset. Node-based surfaces are not supported; if node-based surfaces are imported
into Abaqus/CAE, they are treated as sets.
Required parameters
-
NAME
-
Set this parameter equal to a label that will be used to refer to the surface.
Required parameter for cavity radiation simulations
-
PROPERTY
-
This parameter applies only to Abaqus/Standard analyses.
Set this parameter equal to the name of the SURFACE PROPERTY definition
associated with this surface. See Cavity Radiation in Abaqus/Standard.
Optional parameter for surface tension loads
-
PROPERTY
-
This parameter applies only to Abaqus/Explicit analyses.
Set this parameter equal to the name of the SURFACE PROPERTY definition
associated with this surface. See Surface Tension Loads.
Optional parameters
-
COMBINE
-
Set
COMBINE=UNION
to create a surface based on the union of two or more surfaces of the same type.
Set
COMBINE=INTERSECTION
to create a surface based on the intersection of two surfaces of the same type.
Set
COMBINE=DIFFERENCE
to create a surface based on the difference of two surfaces of the same type (the
second surface is subtracted from the first).
Only the NAME parameter and, in
cavity radiation simulations, the
PROPERTY parameter can be used in
conjunction with this parameter.
-
CROP
-
Include this parameter to create a new surface that will contain only those faces
from an existing surface that have nodes in a specified rectangular box.
Only the NAME parameter and, in
cavity radiation simulations, the
PROPERTY parameter can be used in
conjunction with this parameter.
-
DEFINITION
-
This parameter is relevant only for surfaces defined using
TYPE=CUTTING SURFACE.
Set
DEFINITION=COORDINATES
(default) to define the cutting plane by giving the coordinates of a point on the
cutting plane and the normal to the cutting plane.
Set
DEFINITION=NODES
to define the cutting plane by giving global node numbers for point
a on the cutting plane and point b that
lies off the cutting plane with the cutting plane normal determined by the vector from
a to b.
-
FILLET RADIUS
-
This parameter can be used with
TYPE=SEGMENTS,
TYPE=CYLINDER,
or TYPE=
REVOLUTION to define a radius of
curvature to smooth discontinuities between adjoining straight-line segments,
adjoining circular-arc segments, and adjoining straight-line and circular-arc
segments.
-
INTERNAL
-
Abaqus/CAE uses the INTERNAL parameter to
identify surfaces that are created internally. The
INTERNAL parameter is used only in
models defined in terms of an assembly of part instances. The default is to omit the
INTERNAL parameter.
-
REGION TYPE
-
This parameter is relevant only for surfaces defined on the boundary of an adaptive
mesh domain. A surface defined in the interior of an adaptive mesh domain will move
independently of the material unless the surface is constrained by mesh constraints.
See Defining ALE Adaptive Mesh Domains in Abaqus/Explicit.
Set
REGION TYPE=LAGRANGIAN
to create a Lagrangian boundary region. The edge of a Lagrangian boundary region will
follow the material while allowing adaptive meshing along the edge and within the
interior of the region.
Set
REGION TYPE=SLIDING
(default) to create a sliding boundary region. The edge of a sliding boundary region
will slide over the material. Adaptive meshing will occur on the edge and within the
interior of the region. Mesh constraints are typically applied on the edge of a
sliding boundary region to fix it spatially.
Set
REGION TYPE=EULERIAN
to create an Eulerian boundary region in an adaptive mesh domain. This option is used
to create a boundary region across which material can flow. Mesh constraints must be
used normal to an Eulerian boundary region to allow material to flow through the
region. If no mesh constraints are applied, an Eulerian boundary region will behave in
the same way as a sliding boundary region.
-
TRIM
-
Set
TRIM=YES
to invoke trimming of open free surfaces. Set
TRIM=NO
to suppress surface trimming. The default value is
TRIM=YES
unless the surface is used as a main surface in a finite-sliding contact formulation
in Abaqus/Standard or the surface is used with the contact pair algorithm in Abaqus/Explicit.
TRIM=YES
has no effect on surfaces used with the contact pair algorithm in Abaqus/Explicit.
-
TYPE
-
Set
TYPE=ELEMENT
(default) to define a free surface automatically for the elements specified or to
define a surface on the elements by using element face identifiers.
Set
TYPE=NODE
to define a surface by specifying a list of nodes or node set labels.
Set
TYPE=SEGMENTS
to create a two-dimensional analytical surface in the
plane for planar models or in the
plane for axisymmetric models by defining connected line segments.
Set
TYPE=CYLINDER
to define a three-dimensional analytical surface by sweeping connected line segments
defined in a local (x, y) plane along a
specified generator vector.
Set
TYPE=REVOLUTION
to define a three-dimensional analytical surface by providing connected line segments,
which are given in an
plane and are rotated about an axis.
Set
TYPE=CUTTING SURFACE
to generate an interior element-based surface using a cutting plane passing through an
element set. The generated surface is an approximation to the cutting plane.
Set
TYPE=EULERIAN MATERIAL
to define a surface on the exterior boundary of an Eulerian material instance. This
option applies only to Abaqus/Explicit.
Set
TYPE=USER
to define an analytical surface via user subroutine RSURFU in Abaqus/Standard.
Set
TYPE=XFEM
to generate a crack surface for enriched cracked elements. This option applies only to
Abaqus/Standard. Crack surfaces for XFEM are
not supported with the CONTACT PAIR option.
Data lines for
COMBINE=UNION
- First line
-
List of surfaces.
Repeat this data line as often as necessary. Up to 16 entries are
allowed per line.
Data line for
COMBINE=INTERSECTION
or
COMBINE=DIFFERENCE
- First (and only) line
-
First surface name.
Second surface name.
For
COMBINE=DIFFERENCE
the second surface is subtracted from the first.
Data lines to define a surface when the
CROP parameter is included
- First line
-
Surface name.
- Second line
-
X-coordinate of the lower box corner.
Y-coordinate of the lower box corner.
Z-coordinate of the lower box corner.
X-coordinate of the opposite box corner.
Y-coordinate of the opposite box corner.
Z-coordinate of the opposite box corner.
- Third line (optional)
-
X-coordinate of the first point defining the
orientation.
Y-coordinate of the first point defining the
orientation.
Z-coordinate of the first point defining the
orientation.
X-coordinate of the second point defining the
orientation.
Y-coordinate of the second point defining the
orientation.
Z-coordinate of the second point defining the
orientation.
Data lines to define a surface using elements or element sets when the
TYPE=ELEMENT
parameter is used
- First line
-
Element set name or element number. In Abaqus/Explicit a blank data line can be specified to automatically generate the exterior
(free) faces of every element in the model.
Face or edge identifier label (see Element-Based Surface Definition for
the face and edge identifiers for various elements) or the “word”
EDGE (optional).
Repeat this data line as often as necessary to define the
surface.
Data lines to define a surface using nodes or node sets when the
TYPE=NODE
parameter is used
- First line
-
Node set name or node number.
Cross-sectional area or distributing weight factor. In Abaqus/Standard contact calculations, the default is the area specified in the associated SURFACE INTERACTION option
if the surface is defined in a contact pair; otherwise, a unit area is used. In
Abaqus/Explicit the cross-sectional area used for contact pair calculations for node-based
surface nodes is always set to 1.0 regardless of the value specified here. If the
surface is used in a COUPLING or SHELL TO SOLID COUPLING
definition, the default distributing weight factor is zero in Abaqus/Standard and 1.0 in Abaqus/Explicit.
Repeat this data line as often as necessary to define the
surface.
Data lines to define a surface using a plane cutting through the given element
sets when
TYPE=CUTTING SURFACE,
DEFINITION=COORDINATES
- First line
-
X-coordinate of a point on the cutting plane in the
initial configuration.
Y-coordinate of a point on the cutting plane in the
initial configuration.
Z-coordinate of a point on the cutting plane in the
initial configuration.
X-component of a normal to the cutting plane in the
initial configuration.
Y-component of a normal to the cutting plane in the
initial configuration.
Z-component of a normal to the cutting plane in the
initial configuration.
- Second line
-
List of elements or element set labels to be cut by the cutting plane to
generate an element-based surface that is an approximation to the cutting plane. A
blank data line can be specified to generate a surface by cutting the whole model.
Repeat this data line as often as necessary. Up to 16 entries are
allowed per line.
Data lines to define a surface using a plane cutting through the given element
sets when
TYPE=CUTTING SURFACE,
DEFINITION=NODES
- First line
-
Node number of the node at point a.
Node number of the node at point b.
- Second line
-
List of elements or element set labels to be cut by the cutting plane to
generate an element-based surface that is an approximation to the cutting plane. A
blank data line can be specified to generate a surface by cutting the whole model.
Repeat this data line as often as necessary. Up to 16 entries are
allowed per line.
Data line to define surfaces created with
TYPE=EULERIAN MATERIAL
- First line
-
Name of the material instance as defined in the EULERIAN SECTION.
Abaqus/Explicit will automatically create a surface on the exterior of the given material.
Data lines to define a crack surface created with
TYPE=XFEM
- First line
-
List of names of the enriched features as defined with the ENRICHMENT option.
Abaqus/Standard will automatically generate a crack surface as the enriched elements crack.
Repeat this data line as often as necessary. Up to 16 entries are
allowed per line.
No data lines are needed for
TYPE=USER
Data lines to define surfaces created with
TYPE=SEGMENTS
- First line
-
The “word” START.
Global X-coordinate or
r-coordinate of the starting point of the line segments.
Global Y-coordinate or
z-coordinate of the starting point of the line segments.
Second and subsequent data lines define the various line, circular, and parabolic
segments (see below for their format) that form the profile of the analytical surface.
Data lines to define surfaces created with
TYPE=CYLINDER
- First line (leave blank if this surface is being defined within a part or a
part instance)
-
Global X-coordinate of point a,
the origin of the local
system (see Figure 1).
Global Y-coordinate of point a,
the origin of the local
system.
Global Z-coordinate of point a,
the origin of the local
system.
Global X-coordinate of point b
on the local x-axis.
Global Y-coordinate of point b
on the local x-axis.
Global Z-coordinate of point b
on the local x-axis.
- Second line (leave blank if this surface is being defined within a part or
a part instance)
-
Global X-coordinate of point c
on the local cylinder generator vector.
Global Y-coordinate of point c
on the local cylinder generator vector.
Global Z-coordinate of point c
on the local cylinder generator vector.
- Third line
-
The “word” START.
Local x-coordinate of the starting point of the line
segments.
Local y-coordinate of the starting point of the line
segments.
Fourth and subsequent data lines define the various line, circular, and parabolic
segments (see below for their format) that form the profile of the analytical surface.
Data lines to define surfaces created with
TYPE=REVOLUTION
- First line (leave blank if this surface is being defined within a part or a
part instance)
-
Global X-coordinate of point a,
the origin of the local
system (see Figure 2).
Global Y-coordinate of point a,
the origin of the local
system.
Global Z-coordinate of point a,
the origin of the local
system.
Global X-coordinate of point b
on the symmetry axis (the local z-axis).
Global Y-coordinate of point b
on the symmetry axis (the local z-axis).
Global Z-coordinate of point b
on the symmetry axis (the local z-axis).
- Second line
-
The “word” START.
Local r-coordinate of the starting point of the line
segments.
Local z-coordinate of the starting point of the line
segments.
Third and subsequent data lines define the various line, circular, and parabolic
segments (see below for their format) that form the profile of the analytical surface.
Data lines that define the line segments that form the analytical surface for
TYPE=SEGMENTS,
TYPE=CYLINDER,
and
TYPE=REVOLUTION
- Data line to define a straight line segment
-
The “word” LINE.
x-coordinate of the end point of the line.
y-coordinate of the end point of the line.
- Data line to define a circular arc segment (the arc must be less than
179.74°)
-
The “word” CIRCL.
x-coordinate of the end point of the circular arc.
y-coordinate of the end point of the circular arc.
x-coordinate of the center (origin) of the circular
arc.
y-coordinate of the center (origin) of the circular
arc.
- Data line to define a parabolic arc segment
-
The “word” PARAB.
Local x-coordinate of the middle point along the
parabolic arc.
Local y-coordinate of the middle point along the
parabolic arc.
Local x-coordinate of the end point of the parabolic
arc.
Local y-coordinate of the end point of the parabolic
arc.
For surfaces created with
TYPE=SEGMENTS,
the x- and y-coordinates are the global
X- and Y-coordinates or
r- and z-coordinates. For surfaces created
with
TYPE=CYLINDER,
the x- and y-coordinates are the local
x- and y-coordinates. For surfaces created
with
TYPE=REVOLUTION,
the x- and y-coordinates are the local
r- and z-coordinates.
|