ProductsAbaqus/StandardAbaqus/ExplicitAbaqus/CAE
TypeModel data
LevelPartPart instanceAssembly
Abaqus/CAEMesh module
Required parameters
- TYPE
-
Set this parameter equal to the element type, as defined in
About the Element Library.
For user elements, specify the Un
type identification (see User-Defined Elements). The
USER ELEMENT option must also
appear in the same input file.
For substructures, specify SUBSTR or
Zn type identification.
The preferred setting is
TYPE=SUBSTR.
For more information, see Using Substructures.
Optional parameters
- ELSET
-
Set this parameter equal to the name of the element set to which these
elements will be assigned.
- FILE
-
This parameter applies only to Abaqus/Standard analyses. This parameter is meaningful only for substructures.
For
TYPE=SUBSTR,
set this parameter equal to the substructure name, which is used to name the
substructure database files. If the substructure database files are located outside of
the user directory, the FILE
parameter value must include the relative path to the file location (see Using Substructures).
For
TYPE=Zn,
set this parameter equal to the prefix in the substructure name (see the SUBSTRUCTURE GENERATE,
LIBRARY option).
See Input Syntax Rules for the
syntax of such file names.
- INPUT
-
Set this parameter equal to the name of the alternate input file containing
the data lines for this option. See
Input Syntax Rules
for the syntax of such file names. If this parameter is omitted, it is assumed
that the data follow the keyword line.
-
OFFSET
-
When the ELEMENT option is used to
define the connectivity of axisymmetric elements with asymmetric deformation in Abaqus/Standard, set this parameter equal to a positive offset number for use in specifying the
additional nodes required in the connectivity (see Element Definition for more
information). The default is
OFFSET=100000.
When the ELEMENT option is used to
define the connectivity of gasket elements in Abaqus/Standard or cohesive elements, set the
OFFSET parameter equal to a positive
offset number for use in defining the remaining nodes of the element when only part of
the element nodes are defined explicitly. If this parameter is omitted, you must
specify the connectivity of the entire gasket or cohesive element on the data lines
(see Defining the Gasket Element's Initial Geometry and Defining the Cohesive Element's Initial Geometry).
When the ELEMENT option is used to
define the connectivity of thermal fluid pipe elements or thermal fluid pipe connector
elements in Abaqus/Standard, set the OFFSET parameter equal
to a positive offset number for use in defining the remaining nodes of the element
when only the first two element nodes are defined explicitly. If this parameter is
omitted, you must specify the connectivity of the entire element on the data lines
(see Fluid Pipe Element Library and Fluid Pipe Connector Element Library).
- SOLID ELEMENT NUMBERING
-
This parameter applies only to
Abaqus/Standard
analyses.
This parameter can be used only when the
ELEMENT option is used to define gasket elements. Use this
parameter to specify the connectivity of gasket elements using the node
ordering of an equivalent solid element. Set it equal to the face number of the
equivalent solid element that corresponds to the first face
(SNEG) of the gasket element. If no value is
assigned to this parameter, it is assumed that the first face
(S1) of the solid element corresponds to the
first face of the gasket element.
Data lines to
define the elements
- First
line
-
Element number.
-
First node number forming the element.
-
Second node number forming the element.
-
Etc., up to 15 node numbers on this line.
The order of nodes for each element type (the element's connectivity) is
given in
About the Element Library.
- Continuation lines (only required if the previous line ends with a
comma)
-
-
Node numbers forming the element.
Repeat this set of data lines as often as necessary, with up
to 16 integer values per
line.