You can view a composite
layup while you are creating it or after it has been analyzed.
Abaqus/CAE
provides the following tools for ply-based visualization of a composite
layup:
Ply
stack plot
A ply stack plot is a graphical representation of the plies from the
selected region of a composite layup or a composite section.
Figure 1
illustrates a ply stack plot.
Figure 1. A ply stack plot.
The staircase appearance does not indicate ply drop-offs in the layup; it is
simply a graphical representation that allows you to see the number of plies in
the layup and, for example, the relative thickness of a ply, the material from
which it is constructed, and the orientation of its fibers. If your composite
layup contains many plies, the ply stack plot can become confusing and hard to
interpret. To make the ply stack plot more readable,
Abaqus/CAE
provides options that allow you to view only a manageable number of plies.
The triad in a ply stack plot represents the element orientation system,
and it shows the shell normal or stacking direction (the 3-direction) and the
1- and 2-directions for the plies. The fibers are always drawn in the 1–2 plane
at an angle with respect to the 1-direction. In solid composite layups the
fibers in a ply do not always run parallel to the 1–2 plane (e.g., if the
3-direction of the ply orientation and the element stacking direction are not
aligned). In this situation the fibers in the ply stack plot are not a true
depiction of the fibers in the layup, but rather a graphical representation of
the rotation angles in the layup definition: the angle drawn in the ply stack
plot is the rotation angle specified in the ply table measured about the
element stacking direction axis. For more information, see
Understanding composite layups and orientations.
Ply stack plots do not draw fibers for ply orientations that are based on a
user-defined coordinate system or a rotation angle distribution.
Abaqus/CAE
displays an asterisk (for coordinate systems) or a caret (for rotation angle
distributions) on such plies to signify that it cannot draw lines in the 1–2
plane that accurately represent the fiber direction for the ply. Similarly, if
you use a discrete field distribution to define a ply's thickness,
Abaqus/CAE
draws the ply in the ply stack plot based on the average thickness of the other
uniform plies in the layup and displays the discrete field name next to the
plot (if thickness labels are turned on).
You can display a ply stack plot in the
Property module
after you have created a composite layup. You can also display a ply stack plot
in
the Visualization module
after you have analyzed a model with a composite layup. For more information,
see
Viewing a ply stack plot.
Ply-based
results
After you have analyzed a model with a composite layup, you can view a
contour plot of results from individual plies of the layup, or you can view an
envelope contour plot that looks for maximum or minimum values across all of
the plies in the layup.
Results from individual
plies
Ply-based results show the data from a selected ply in a composite layup.
For a given ply, you can view data from the bottom, middle, or top of the ply,
or you can view data from both the top and bottom plies.
Figure 2
illustrates a contour plot of strain (E11) from selected plies of a composite layup.
Figure 2. Contour plots from selected plies.
If the same ply name is used in multiple composite layup definitions within
a model, viewing data for this ply displays results for all layups in which the
ply name appears. To limit the results to a single ply within a single layup,
you must first use a display group to limit the display to the individual
composite layup (see
Selection methods for creating or editing a display group),
then plot the results for a section point within the desired ply (see
Selecting section point data by ply).
Contour plots displaying output at both the top and bottom plies of a
composite layup vary in appearance depending on the type of layup. In a
conventional shell composite layup the two contours appear as a single
double-sided shell with different contours on each side. In a continuum shell
composite layup or solid composite layup the two contours appear as distinct
single-sided contours at each section point location.
Figure 3
illustrates the difference between contour plots of conventional shell and
continuum shell composite layups.
Figure 3. Contour plots of conventional shell and continuum shell composite
layups.
Each layup contains three plies, and each plot is showing the output from
the top of the top ply and from the bottom of the bottom ply. Stress (S11) is plotted in both cases. For more information, see
Selecting section point data by category.
Envelope
plots
An envelope plot allows you to view a contour plot of the highest or lowest
value of a variable in your model, regardless of the ply in which it is
occurring. The plies in an envelope plot that correspond with the extreme
values are called the critical plies. You can choose the criterion that
Abaqus/CAE
applies (absolute maximum, maximum, or minimum) and the position in the ply at
which
Abaqus/CAE
checks the value (integration point, centroid, element nodal).
For example, even though your composite layup can include a large number of
plies, you can view only the critical plies and determine the highest strain
that is occurring in each element of your model. You can decide if you want to
reduce the strain in the critical plies by increasing the number of plies in a
particular region or by reorienting existing plies.
Figure 4
shows the value of the strain (E11) in the critical plies of the model.
Figure 4. The value of the strain in the critical plies.
In addition, you can use the contour plot options to display a quilt contour
plot where the color of each element indicates which ply is the critical ply,
as shown in
Figure 5.
If you do not create an output request,
Abaqus/CAE
writes field output data from only the top and bottom of a composite layup, and
no data are generated from the other plies. To create an envelope plot that
examines all of the plies in your model, you must create a new output request
or edit the default output request and specify the composite layup and the
plies and section points from which variables will be output.
In many cases, even though you change the position in the ply at which
Abaqus/CAE
checks the value, the same ply experiences the extreme value, and the contour
plot does not change. However, the contour plot might change because the
critical ply changed if:
you have a small number of plies, and the results are changing rapidly
through the thickness of the ply; or
the material is nonlinear, and its stiffness changes abruptly under some
conditions.
Through thickness
X–Y plots
After you have analyzed a composite layup and determined which regions
contain the critical plies, you can view the behavior of the plies across the
layup with a through thickness X–Y plot. You can create an
X–Y data object by reading field output results from
the section points in a selected element of a shell region of your model. If
you select an element in a composite layup,
Abaqus/CAE
plots data for each section point in each ply across the entire thickness of
the layup.
Figure 6
illustrates a through thickness plot of the strain in the fiber direction
through 13 plies of a composite layup. The strain is discontinuous because the
orientation of the fiber changes between plies.
You can use color coding in all of the
Abaqus/CAE
modules to change the color of individual layups and plies. If you choose to
color code by plies,
Abaqus/CAE
displays only one ply in a region, which by default is the last ply (in
alphabetical order). To view a different ply, you can deactivate selected
plies. For more information, see
Coloring geometry and mesh elements.
Using a composite layup to model a yacht hull,
illustrates how you can create and analyze a complex three-dimensional
composite model and how you can use
Abaqus/CAE
to view the behavior of individual plies in the layup.
