can be used in a purely acoustic analysis or in a coupled acoustic-structural analysis
such as the calculation of shock waves in a fluid or noise levels in a vibration problem;
is an elastic medium (usually a fluid) in which stress is purely hydrostatic (no shear
stress) and pressure is proportional to volumetric strain;
is specified as part of a material definition;
must appear in conjunction with a density definition (see Density);
can include fluid cavitation in Abaqus/Explicit when the absolute pressure drops to a limit value;
can be defined as a function of temperature and/or field variables;
can include dissipative effects;
can model small pressure changes (small amplitude excitation);
can model waves in the presence of steady underlying flow of the medium; and
The equilibrium equation for small motions of a compressible, inviscid fluid flowing
through a resisting matrix material is taken to be
where p is the dynamic pressure in the fluid (the pressure
in excess of any initial static pressure), is the spatial position of the fluid particle, is the fluid particle velocity, is the fluid particle acceleration, is the density of the fluid, and is the “volumetric drag” (force per unit volume per velocity) caused by
the fluid flowing through the matrix material. The d'Alembert term has been written without
convection on the assumption that there is no steady flow of the fluid, which is usually
considered to be sufficiently accurate for steady fluid velocities up to Mach 0.1.
The constitutive behavior of the fluid is assumed to be inviscid and compressible, so that
the bulk modulus of an acoustic medium relates the dynamic pressure in the medium to the
volumetric strain by
where is the volumetric strain. Both the bulk modulus and the density of an acoustic medium must be defined.
The bulk modulus can be defined as a function of temperature and field variables but does
not vary in value during an implicit dynamic analysis using the subspace projection method
(Implicit Dynamic Analysis Using Direct Integration) or a
direct-solution steady-state dynamic analysis (Direct-Solution Steady-State Dynamic Analysis); for these
procedures the value of the bulk modulus at the beginning of the step is used.
Input File Usage
Use both of the following options to define an acoustic medium:
Property module: material editor:
OtherAcoustic Medium: Bulk ModulusGeneralDensity
Volumetric Drag
Dissipation of energy (and attenuation of acoustic waves) might occur in an acoustic medium
due to a variety of factors. Such dissipation effects are phenomenologically characterized
in the frequency domain by the imaginary part of the propagation constant, which gives an
exponential decay in amplitude as a function of distance. In Abaqus the simplest way to model this effect is through a “volumetric drag coefficient,” (force per unit volume per velocity).
In frequency-domain procedures, might be frequency dependent. can be entered as a function of frequency—, where f is the frequency in cycles per time (usually
Hz)—in addition to temperature and/or field variables only when the acoustic medium is used
in a steady-state dynamics procedure. If the acoustic medium is used in a direct-integration
dynamic procedure (including Abaqus/Explicit), the volumetric drag coefficient is assumed to be independent of frequency and the first
value entered for the current temperature and/or field variable is used.
In all procedures except direct steady-state dynamics the gradient of is assumed to be small.
Property module: material editor: OtherAcoustic Medium: Volumetric Drag: Include volumetric drag
Porous Acoustic Material Models
Porous materials are commonly used to suppress acoustic waves; this attenuating effect
arises from a number of effects as the acoustic fluid interacts with the solid matrix. For
many categories of materials, the solid matrix can be approximated as either fully rigid
compared to the acoustic fluid or fully limp. In these cases a mechanical model that
resolves only acoustic waves will suffice. The acoustic behavior of porous materials can be
modeled in a variety of ways in Abaqus/Standard.
Craggs Model
The model discussed in Craggs (1978) is readily accommodated in Abaqus. Applying this model results in the dynamic equilibrium equation for the fluid
expressed in this form:
where is the real-valued resistivity, is the real-valued dimensionless porosity, is the dimensionless “structure factor,” and is the dimensionless wave number. This equation can be rewritten as
This model, therefore, can be applied straightforwardly in Abaqus by setting the material density equal to , the volumetric drag equal to , and the bulk modulus equal to . The Craggs model is supported for all acoustic procedures in Abaqus.
Delany-Bazley and Delany-Bazley-Miki Models
Abaqus/Standard supports the well-known empirical model proposed in Delany & Bazley (1970), which determines the material properties as a
function of frequency and user-defined flow resistivity, ; density, ; and bulk modulus, . A variation on this model, proposed by Miki (1990) is also available. These models are supported only for steady-state
dynamic procedures.
Both models compute frequency-dependent material characteristic impedance, , and wavenumber or propagation constant, , according to the following formula:
where
and
The constants are as given in the table below:
Delany- Bazley
0.0978
–0.7
0.189
–0.595
0.0571
–0.754
0.087
–0.732
Miki
0.1227
–0.618
0.1792
–0.618
0.0786
–0.632
0.1205
–0.632
The material characteristic impedance and the wavenumber are converted internally to
complex density and complex bulk modulus for use in Abaqus. The signs of the imaginary parts in these formulas are consistent with the Abaqus sign convention for time-harmonic dynamics.
Porous acoustic material models are not supported in Abaqus/CAE.
General Frequency-Dependent Models
For steady-state dynamic procedures, Abaqus/Standard supports general frequency-dependent complex bulk modulus and complex density. Using
these parameters, data from a wide range of models can be accommodated in an analysis; for
example, see Allard, et. al (1998), Attenborough (1982), Song & Bolton (1999), and Wilson (1993). These models are used in a variety of applications, such as ocean
acoustics, aerospace, automotive, and architectural acoustic engineering.
The signs of these parameters must be consistent with the sign conventions used in Abaqus, and with conservation of energy. Abaqus uses a Fourier transform pair formally equivalent to assuming time dependence. Consequently, the real parts of the density and bulk
modulus are positive for all values of frequency, the imaginary part of the bulk modulus
must be positive, and the imaginary part of the density must be negative.
A linear isotropic acoustic material can be fully described with the two
frequency-dependent parameters: bulk modulus, , and density, . It is common, however, to encounter materials defined in terms of other
parameter pairs, such as characteristic impedance, , wave number or propagation constant, , or speed of sound, . Data defined with the pair or can be converted into the complex density and bulk modulus form,
beginning from the following standard formulas:
Consistent with the Abaqus sign conventions, the real parts of and must be positive; the imaginary part of must be negative, and the imaginary part of must be positive. In commonly observed materials, the ratio of the
magnitude of the imaginary part to the real part for each of these constants is usually
much less than one.
Input File Usage
Use the following option to use the general frequency-dependent model:
ACOUSTIC MEDIUM, COMPLEX BULK MODULUSACOUSTIC MEDIUM, COMPLEX DENSITY
If desired, either complex material option can be used instead in conjunction with a
real-valued, frequency-independent material option:
General frequency-dependent acoustic material models are not supported in Abaqus/CAE.
Conversion from Complex Material Impedance and Wavenumber
Since
and
the real and imaginary parts of are, respectively:
and the real and imaginary parts of are, respectively:
.
Conversion from Complex Impedance and Speed of Sound
Since
and
the real and imaginary parts of are, respectively:
and the real and imaginary parts of are, respectively:
.
Fluid Cavitation
In general, fluids cannot withstand any significant tensile stress and are likely to
undergo large volume expansion when the absolute pressure is close to or less than zero. Abaqus/Explicit allows modeling of this phenomenon through a cavitation pressure limit for the acoustic
medium. When the fluid absolute pressure (sum of the dynamic and initial static pressures)
reduces to this limit, the fluid undergoes free volume expansion (that is, cavitation),
without a further drop in the pressure. If this limit is not defined, the fluid is assumed
not to undergo cavitation even under a tensile, negative absolute pressure, condition.
The constitutive behavior for an acoustic medium capable of undergoing cavitation can be
stated as
where a pseudo-pressure , a measure of the volumetric strain, is defined as
where is the fluid cavitation limit and is the initial acoustic static pressure. A total wave formulation is used
for a nonlinear acoustic medium undergoing cavitation. This formulation is very similar to
the scattered wave formulation except that the pseudo-pressure, defined as the product of
the bulk modulus and the compressive volumetric strain, plays the role of the material state
variable instead of the acoustic dynamic pressure and the acoustic dynamic pressure is
readily available from this pseudo-pressure subject to the cavitation condition.
In the presence of cavitation in Abaqus/Explicit the fluid mechanical behavior is nonlinear. Hence, for an acoustic problem with
incident wave loading and possible cavitation in the fluid, the scattered wave
formulation, which provides a solution for only a scattered wave dynamic acoustic
pressure, might not be appropriate. For these cases the total wave formulation, which
solves for the total dynamic acoustic pressure, should be selected. See Acoustic and Shock Loads for details.
Any module: ModelEdit Attributesmodel_name. Toggle on Specify acoustic wave formulation: Total wave
Defining the Initial Acoustic Static Pressure
Cavitation occurs when the absolute pressure reaches the cavitation limit value. Abaqus/Explicit allows for an initial linearly varying hydrostatic pressure in the fluid medium (see
Defining Initial Acoustic Static Pressure). You can specify pressure values at two locations and a node set of the acoustic
medium nodes. Abaqus/Explicit interpolates from these data to initialize the static pressure at all the nodes in the
specified node set. If the pressure at only one location is specified, the hydrostatic
pressure in the fluid is assumed to be uniform. The acoustic static pressure is used only
for determining the cavitation status of the acoustic element nodes and does not apply any
static loads to the acoustic or structural mesh at their common wetted interface.
Initial acoustic pressures are not supported in Abaqus/CAE.
Defining a Steady Flow Field
Acoustic finite elements can be used to simulate time-harmonic wave propagation and natural
frequency analysis in the presence of a steady mean flow of the medium. For example, air
might move at a speed large enough to affect the propagation speed of waves in the direction
of flow and against it. These effects are modeled in Abaqus/Standard by specifying an acoustic flow velocity during the linear perturbation analysis step
definition; you do not need to alter the acoustic material properties. See Coupled Acoustic-Structural Analysis for details.
In Abaqus/Standard second-order acoustic elements are more accurate than first-order elements. Use at least
six nodes per wavelength in the acoustic medium to obtain accurate results.
Output
You can use nodal output variable PAC
(which is an alias of POR) to output the
pressure magnitude for an acoustic medium. When the scattered wave formulation is used with
incident wave loading in Abaqus/Explicit, output variable POR represents only
the scattered pressure response of the model and does not include the incident wave loading
itself. When the total wave formulation is used, output variable
POR represents the total dynamic acoustic
pressure, which includes contributions from both incident and scattered waves as well as the
dynamic effects of fluid cavitation. For either formulation output variable
POR does not include the acoustic static
pressure, which is used only to evaluate the cavitation status in the acoustic medium.
In addition, in Abaqus/Standard nodal output variable PPOR (the
pressure phase) is available for an acoustic medium. In Abaqus/Explicit nodal output variable PABS (the
absolute pressure, equal to the sum of POR
and the acoustic static pressure) is available for an acoustic medium.
References
Allard, J.F., M. Henry, J. Tizianel, L. Kelders, and W. Lauriks, “Sound
Propagation in Air-Saturated Random Packings of Beads,” Journal of the Acoustical Society of America, vol. 104, no. 42004, 1998.
Attenborough, K.F., “Acoustical Characterisitics of Rigid Fibrous Absorbents and Granular Materials,” Journal of the Acoustical Society of America, vol. 73, no. 3785, 1982.
Craggs, A., “A Finite Element Model for Rigid Porous Absorbing Materials,” Journal of Sound and Vibration, vol. 61, no. 1101, 1978.
Craggs, A., “Coupling of Finite Element Acoustic Absorption Models,” Journal of Sound and Vibration, vol. 66, no. 4605, 1979.
Delany, M.E., and E. N. Bazley , “Acoustic Properties of Fibrous Absorbent Materials,” Applied Acoustics, vol. 3105, 1970.
Miki, Y., “Acoustical Properties of Porous Materials - Modifications of Delany-Bazley Models,” Journal of the Acoustical Society ofJapan ( E), vol. 11, no. 119, 1990.
Song, B.H., and J. S. Bolton, “A Transfer-Matrix Approach for Estimating the Characteristic Impedance and
Wavenumbers of Limp and Rigid Porous Materials,” Journal of the Acoustical Society of America, vol. 107, no. 31131, 1999.
Wilson, D.K., “Relaxation-Matched Modeling of Propagation through Porous Media, Including Fractal Pore Structure,” Journal of the Acoustical Society of America, vol. 94, no. 21136, 1993.