Switch to the Visualization module, and open the file Crane.odb. Abaqus displays an undeformed shape plot of the crane model.
Plotting the deformed model shape
To begin this exercise, plot the deformed model shape with the undeformed model shape
superimposed on it. Specify a nondefault view using (0, 0, 1) as the
X-, Y-, and
Z-coordinates of the viewpoint vector and (0, 1, 0) as the
X-, Y-, and
Z-coordinates of the up vector.
Tip:
You can
also display the model using this view by clicking
from the Views toolbar.
The undeformed shape of the crane superimposed upon the deformed shape is shown in
Figure 1.
Figure 1. Deformed shape of cargo crane.
Using display groups to plot element and node sets
You can use display groups to plot existing node and element sets; you can also create
display groups by selecting nodes or elements directly from the viewport. You will
create a display group containing only the elements associated with the main members in
truss structure A.
To create and plot a display group:
In the Results Tree, expand the Sections container underneath the output
database file named Crane.odb.
To facilitate your selection, change the view back to the default isometric view
using the
tool in the Views toolbar.
Tip:
If the Views toolbar is not visible, select ViewToolbarsViews from the main menu bar.
In succession, click the items in the container until the elements associated with
the main members in truss A are highlighted in the viewport. Click mouse button 3 on
this item and select Replace from the menu that appears.
Abaqus/CAE now displays only this group of elements.
To save this group, double-click Display Groups in the Results Tree; or use the
tool in the Display Group toolbar.
The Create Display Group dialog box appears.
In the Create Display Group dialog box, click Save
As and enter MainA as the name for
your display group.
Click Dismiss to close the Create Display
Group dialog box.
This display group now appears underneath the Display Groups
container in the Results Tree.
Beam cross-section orientation
You will now plot the section axes and beam tangents on the undeformed model shape.
To plot the beam section axes:
From the main menu bar, select PlotUndeformed Shape; or use the
tool in the toolbox to display only the undeformed
model shape.
From the main menu bar, select OptionsCommon; then, click the Normals tab in the dialog box
that appears.
Toggle on Show normals, and accept the default setting of
On elements.
In the Style area at the bottom of the
Normals page, specify the Length to be
Long.
Click OK.
The section axes and beam tangents are displayed on the undeformed shape.
The resulting plot is shown in Figure 2. The text annotations in Figure 2 that identify the section axes and beam tangent will not appear in your image. The
vector showing the local beam 1-axis, , is blue; the vector showing the beam 2-axis, , is red; and the vector showing the beam tangent, , is white.
Figure 2. Plot of beam section axes and tangents for elements in display group
MainA.
Rendering beam profiles
You will now display an idealized representation of the beam profile and contour the
stress results.
To render beam profiles:
From the main menu bar, select ViewODB Display Options.
The ODB Display Options
dialog box appears.
In the General tabbed page, toggle on Render beam
profiles and accept the default scale factor of 1.
Click OK.
Abaqus/CAE displays beam profiles with the appropriate dimensions and in the correct
orientations. Figure 3 shows the beam profiles on the whole model. Your changes are saved for the
duration of the session.
Figure 3. Cargo crane with beam profiles displayed.
Creating a hard copy
You can save the current image to a file for hard-copy output.
To create a PNG file of the current image:
From the main menu bar, select FilePrint.
The Print dialog box appears.
From the Settings area in the Print
dialog box, select Color as the Rendition
type; and toggle on File as the
Destination.
Select PNG as the
Format, and enter beam as the
File name.
In the Print dialog box, click OK.
Abaqus/CAE creates a PNG file of the current image and
saves it in your working directory as beam.png. You
can print this file using your system's command for printing
PNG files.
Displacement summary
Write a summary of the displacements of all nodes in display group
MainA to a file named
crane.rpt. The peak displacement at the tip of the
crane in the 2-direction is 0.0188 m.
Section forces and moments
Abaqus can provide output for structural elements in terms of forces and moments acting on
the cross-section at a given point. These section forces and moments are defined in the
local beam coordinate system.
To start, toggle off the rendering of beam profiles, which was toggled on above, in the
ODB Display Options dialog box. Display only the elements in display group
MainA by double-clicking that display group in the Results Tree.
Finally, for clarity, reset the view so that the elements are displayed in the 1-2 plane
by clicking
from the Views toolbar.
To create a “bending moment”-type contour plot:
From the list of variable types on the left side of the Field
Output toolbar, select Primary.
From the list of output variables in the center of the toolbar, select
SM.
Abaqus/CAE automatically selects SM1, the first component name in
the list on the right side of the Field Output toolbar, and
displays a contour plot of the bending moment about the beam 1-axis on the deformed
model shape. The deformation scale factor is chosen automatically since geometric
nonlinearity was not considered in the analysis.
Open the Common Plot Options dialog box, and select a
Uniform deformation scale factor of
1.0.
Color contour plots of this type are typically not very useful for one-dimensional
elements such as beams. A more useful plot is a “bending moment”-type plot, which
you can produce using the contour options.
From the main menu bar,
selectOptionsContour; or use the Contour Options
tool in the toolbox.
The Contour Plot Options dialog box appears; by default, the
Basic tab is selected.
In the Contour Type field, toggle on Show tick marks
for line elements.
Click OK.
The plot shown in Figure 4 appears. The magnitude of the variable at each node is now indicated by the
position at which the contour curve intersects a “tick mark” drawn perpendicular to
the element. This “bending moment”-type plot can be used for any variable (not just
bending moments) for any one-dimensional element, including trusses and axisymmetric
shells as well as beams.
Figure 4. Bending moment diagram (moment about beam 1-axis) for elements in display
group MainA. The locations with the highest
stress (created by the bending of the elements) are indicated.