Body force (give magnitude as force per unit volume) in the global
X-direction.
Load ID (*DLOAD): BY
Body force
FL−3
Body force (give magnitude as force per unit volume) in the global
Y-direction.
Load ID (*DLOAD): BZ
Body force
FL−3
Body force (give magnitude as force per unit volume) in the global
Z-direction.
Load ID (*DLOAD): BXNU
Body force
FL−3
Nonuniform body force (give magnitude as force per unit volume) in the global
X-direction, with magnitude supplied via user subroutine
DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DLOAD): BYNU
Body force
FL−3
Nonuniform body force (give magnitude as force per unit volume) in the global
Y-direction, with magnitude supplied via user subroutine
DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DLOAD): BZNU
Body force
FL−3
Nonuniform body force (give magnitude as force per unit volume) in the global
Z-direction, with magnitude supplied via user subroutine
DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DLOAD): CENT(S)
Not supported
FL−4 (ML−3T−2)
Centrifugal load (magnitude defined as , where is the mass density and is the angular speed).
Load ID (*DLOAD): CENTRIF(S)
Rotational body force
T−2
Centrifugal load (magnitude is input as , where is the angular speed).
Load ID (*DLOAD): CORIO(S)
Coriolis force
FL−4T (ML−3T−1)
Coriolis force (magnitude input , where is the mass density and is the angular speed). The load stiffness due to Coriolis loading
is not accounted for in direct steady-state dynamics analysis.
Load ID (*DLOAD): GRAV
Gravity
LT−2
Gravity loading in a specified direction (magnitude is input as acceleration).
Load ID (*DLOAD): HPn(S)
Not supported
FL−2
Hydrostatic pressure on face n, linear in global
Z. A positive pressure is directed into the element.
Load ID (*DLOAD): Pn
Pressure
FL−2
Pressure on face n. A positive pressure is directed into
the element.
Load ID (*DLOAD): PnNU
Not supported
FL−2
Nonuniform pressure on face n with magnitude supplied
via user subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit. A positive pressure is directed into the element.
Load ID (*DLOAD): ROTA(S)
Rotational body force
T−2
Rotary acceleration load (magnitude is input as , where is the rotary acceleration).
Load ID (*DLOAD): ROTDYNF(S)
Not supported
T−1
Rotordynamic load (magnitude is input as , where is the angular velocity).
Load ID (*DLOAD): SBF(E)
Not supported
FL−5T2
Stagnation body force in global X-, Y-,
and Z-directions.
Load ID (*DLOAD): SPn(E)
Not supported
FL−4T2
Stagnation pressure on face n.
Load ID (*DLOAD): TRSHRn
Surface traction
FL−2
Shear traction on face n.
Load ID (*DLOAD): TRSHRnNU(S)
Not supported
FL−2
Nonuniform shear traction on face n with magnitude and
direction supplied via user subroutine UTRACLOAD.
Load ID (*DLOAD): TRVECn
Surface traction
FL−2
General traction on face n.
Load ID (*DLOAD): TRVECnNU(S)
Not supported
FL−2
Nonuniform general traction on face n with magnitude and
direction supplied via user subroutine UTRACLOAD.
Load ID (*DLOAD): VBF(E)
Not supported
FL−4T
Viscous body force in global X-, Y-, and
Z-directions.
Load ID (*DLOAD): VPn(E)
Not supported
FL3T
Viscous pressure on face n, applying a pressure
proportional to the velocity normal to the face and opposing the motion.
Elastic foundation on face n. A positive pressure is
directed into the element.
Distributed Heat Fluxes
Distributed heat fluxes are available for all elements with temperature degrees of
freedom. They are specified as described in Thermal Loads.
*dflux
Load ID (*DFLUX): BF
Body heat flux
JL−3T−1
Heat body flux per unit volume.
Load ID (*DFLUX): BFNU(S)
Body heat flux
JL−3T−1
Nonuniform heat body flux per unit volume with magnitude supplied via user
subroutine DFLUX.
Load ID (*DFLUX): Sn
Surface heat flux
JL−2T−1
Heat surface flux per unit area into face n.
Load ID (*DFLUX): SnNU(S)
Not supported
JL−2T−1
Nonuniform heat surface flux per unit area into face n
with magnitude supplied via user subroutine DFLUX.
Film Conditions
Film conditions are available for all elements with temperature degrees of freedom.
They are specified as described in Thermal Loads.
*film
Load ID (*FILM): Fn
Surface film condition
JL−2T−1−1
Film coefficient and sink temperature (units of ) provided on face n.
Load ID (*FILM): FnNU(S)
Not supported
JL−2T−1−1
Nonuniform film coefficient and sink temperature (units of ) provided on face n with magnitude
supplied via user subroutine FILM.
Radiation Types
Radiation conditions are available for all elements with temperature degrees of
freedom. They are specified as described in Thermal Loads.
*radiate
Load ID (*RADIATE): Rn
Surface radiation
Dimensionless
Emissivity and sink temperature (units of ) provided on face n.
Surface-Based Loading
Distributed Loads
Surface-based distributed loads are specified as described in Distributed Loads.
*dsload
Load ID (*DSLOAD): HP(S)
Pressure
FL−2
Hydrostatic pressure applied to the element surface, linear in global
Z. The pressure is positive in the direction opposite to the
surface normal.
Load ID (*DSLOAD): P
Pressure
FL−2
Pressure applied to the element surface. The pressure is positive in the direction
opposite to the surface normal.
Load ID (*DSLOAD): PNU
Pressure
FL−2
Nonuniform pressure applied to the element surface with magnitude supplied via user
subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit. The pressure is positive in the direction opposite to the surface normal.
Load ID (*DSLOAD): SP(E)
Pressure
FL−4T2
Stagnation pressure applied to the element reference surface.
Load ID (*DSLOAD): TRSHR
Surface traction
FL−2
Shear traction on the element reference surface.
Load ID (*DSLOAD): TRSHRNU(S)
Surface traction
FL−2
Nonuniform shear traction on the element reference surface with magnitude and
direction supplied via user subroutine UTRACLOAD.
Load ID (*DSLOAD): TRVEC
Surface traction
FL−2
General traction on the element reference surface.
Load ID (*DSLOAD): TRVECNU(S)
Surface traction
FL−2
Nonuniform general traction on the element reference surface with magnitude and
direction supplied via user subroutine UTRACLOAD.
Load ID (*DSLOAD): VP(E)
Pressure
FL3T
Viscous surface pressure. The viscous pressure is proportional to the velocity
normal to the element face and opposing the motion.
Distributed Heat Fluxes
Surface-based heat fluxes are available for all elements with temperature degrees of
freedom. They are specified as described in Thermal Loads.
*dsflux
Load ID (*DSFLUX): S
Surface heat flux
JL−2T−1
Heat surface flux per unit area into the element surface.
Load ID (*DSFLUX): SNU(S)
Surface heat flux
JL−2T−1
Nonuniform heat surface flux per unit area into the element surface with magnitude
supplied via user subroutine DFLUX.
Film Conditions
Surface-based film conditions are available for all elements with temperature
degrees of freedom. They are specified as described in Thermal Loads.
*sfilm
Load ID (*SFILM): F
Surface film condition
JL−2T−1−1
Film coefficient and sink temperature (units of ) provided on the element surface.
Load ID (*SFILM): FNU(S)
Surface film condition
JL−2T−1−1
Nonuniform film coefficient and sink temperature (units of ) provided on the element surface with magnitude supplied via user
subroutine FILM.
Radiation Types
Surface-based radiation conditions are available for all elements with temperature
degrees of freedom. They are specified as described in Thermal Loads.
*sradiate
Load ID (*SRADIATE): R
Surface radiation
Dimensionless
Emissivity and sink temperature (units of ) provided on the element surface.
Element Output
If a local coordinate system is not assigned to the element, the stress/strain
components, as well as the section forces/strains, are in the default directions on the
surface defined by the convention given in Conventions. If a local
coordinate system is assigned to the element through the section definition (Orientations), the
stress/strain components and the section forces/strains are in the surface directions
defined by the local coordinate system.
The local directions defined in the reference configuration are rotated into the
current configuration by the average material rotation.
In the case of composite shells the components of section forces, section strains, and
transverse shear stress estimates for stacked continuum shells
(CTSHR13 and
CTSHR23) are reported in the local
orientation defined for the entire section (or the default shell coordinate directions if
no section orientation is used). Components of stress, strain, and transverse shear stress
(TSHR13 and
TSHR23) are given with respect to the
individual layer orientations.
Stress, Strain, and Other Tensor Components
Stress and other tensors (including strain tensors) are available. All tensors have
the same components. For example, the stress components are as follows:
S11
Local direct stress.
S22
Local direct stress.
S12
Local shear stress.
The stress in the thickness direction, , is reported as zero to the output database as discussed in Abaqus/Standard Output Variable Identifiers. might be obtained through the average section stress variable
SSAVG6. Output of in-plane stress
components of continuum shell elements does not include Poisson effects due to changes
in the thickness direction.
Heat Flux Components
Available for elements with temperature degrees of freedom.
HFL1
Heat flux in the X-direction.
HFL2
Heat flux in the Y-direction.
HFL3
Heat flux in the Z-direction.
Section Forces, Moments, and Transverse Shear Forces
SF1
Direct membrane force per unit width in local 1-direction.
SF2
Direct membrane force per unit width in local 2-direction.
SF3
Shear membrane force per unit width in local 1–2 plane.
SF4
Transverse shear force per unit width in local 1-direction.
SF5
Transverse shear force per unit width in local 2-direction.
SF6
Thickness stress integrated over the element thickness.
SM1
Bending moment force per unit width about local 2-axis.
SM2
Bending moment force per unit width about local 1-axis.
SM3
Twisting moment force per unit width in local 1–2 plane.
The section force and moment resultants per unit length in the normal basis directions
in a given shell section of thickness h can be defined on this
basis as
where stress in the thickness direction is constant through the thickness. Outputs of in-plane section forces
of continuum shell elements do not include Poisson effects due to changes in the
thickness direction.
Average Section Stresses
SSAVG1
Average membrane stress in local 1-direction.
SSAVG2
Average membrane stress in local 2-direction.
SSAVG3
Average membrane stress in local 1–2 plane.
SSAVG4
Average transverse shear stress in local 1-direction.
SSAVG5
Average transverse shear stress in local 2-direction.
SSAVG6
Average thickness stress in the local 3-direction.
The average section stresses are defined as
where and h is the current section thickness. is constant through the thickness.
Section Strains, Curvatures, and Transverse Shear Strains
Section thickness, which is the current section thickness if geometric
nonlinearity is considered; otherwise, it is the initial section thickness.
Transverse Shear Stress Estimates
TSHR13
13-component of transverse shear stress.
TSHR23
23-component of transverse shear stress.
Estimates of the transverse shear stresses are available at section integration points
as output variables TSHR13 or
TSHR23 for both Simpson's rule and
Gauss quadrature. For Simpson's rule output of variables
TSHR13 or
TSHR23 should be requested at
nondefault section points, since the default output is at section point 1 of the shell
section where the transverse shear stresses vanish.
For numerically integrated sections, estimates of the interlaminar shear stresses in
composite sections—that is, the transverse shear stresses at the interface between two
composite layers—can be obtained only by using Simpson's rule. With Gauss quadrature no
section integration point exists at the interface between composite layers.
Unlike the S11,
S22, and
S12 in-surface stress components,
TSHR13 and
TSHR23 are not calculated from the
constitutive behavior at points through the shell section. They are estimated by
matching the elastic strain energy associated with shear deformation of the shell
section with that based on piecewise quadratic variation of the transverse shear stress
across the section, under conditions of bending about one axis (see Transverse shear stiffness in composite shells and offsets from the midsurface). Therefore,
interlaminar shear stress calculation is supported only when each layer of the shell
section is defined using an elastic material model or a user-defined material model with
the elastic transverse shear moduli defined. If you specify the transverse shear
stiffness values, interlaminar shear stress output is not available.
TSHR13 and
TSHR23 are valid only for sections
that have one element through the thickness direction. For sections with two or more
continuum shell elements stacked in the thickness direction, output variables
SSAVG4 and
SSAVG5 or
CTSHR13 and
CTSHR23 should be used instead. An
example using SSAVG4 and
SSAVG5 to estimate the transverse
shear stress distribution in stacked continuum shells can be found in Composite shells in cylindrical bending.
Transverse Shear Stress Estimates for Stacked Continuum Shells
CTSHR13
13-component of transverse shear stress for stacked continuum shells.
CTSHR23
23-component of transverse shear stress for stacked continuum shells.
Estimates of the transverse shear stresses that take into account the continuity of
interlaminar transverse shear stress for stacked continuum shells are available at
section integration points as output variables
CTSHR13 or
CTSHR23 for both Simpson's rule and
Gauss quadrature. CTSHR13 or
CTSHR23 are available only in Abaqus/Standard.
CTSHR13 and
CTSHR23 are not calculated from the
constitutive behavior at points through the shell section. They are estimated by
assuming a quadratic variation of shear stress across the element section and by
enforcing the continuity of interface transverse shear between adjoining continuum
elements in a stack. It is also assumed that the transverse shear is zero at the free
boundaries of a stack.
The intended use case for CTSHR13 and
CTSHR23 is to estimate the
through-the-thickness transverse shear stress for flat or nearly flat composite plates
that are modeled with stacked continuum shell elements where each continuum element in
the stack models a single material layer. Central to
CTSHR13 and
CTSHR23 is the concept of a
stack of continuum shell elements.
During input file preprocessing Abaqus partitions all the continuum shells in a model into stacks. A stack is
defined as a contiguous set of continuum shells whose first and last elements lie on a
free boundary and who are connected through shared nodes on the top and bottom element
surfaces (as determined by the elements' stack directions). In this context a
free boundary is a top or bottom surface of a continuum shell element
that is not connected through its nodes to another continuum shell element. For example,
assuming that the stack direction of all the elements in Figure 1 is in the z-direction, elements 1–6 would form a stack.
Figure 1. Composite plate meshed with six stacked continuum shells through the
thickness.
It is important to emphasize that stacks of continuum shells are connected through
shared nodes, not through constraints or other elements. Suppose, for example, that in
Figure 1 element pairs 1–2, 2–3, 4–5, and 5–6 are connected to each other through shared
nodes, but elements 3 and 4 are connected through a constraint (such as a tied
constraint). In that case Abaqus would interpret the bottom surface of element 3 and the top surface of element 4 as
free boundaries; therefore, elements 1–3 would form one stack, and elements 4–6 would
form a second independent stack. For another example, suppose that element 4 is not a
continuum shell element. In this case elements 1–3 would form one stack, and elements
5–6 would form another stack. In a final example, suppose the stack directions of
elements 1–5 are in the global z-direction and the stack direction
of element 6 is in the global x-direction. In this case elements
1–5 would form a stack separate from element 6. In the three cases just discussed the
computed values of CTSHR13 and
CTSHR23 would probably not be what you
wanted. It is more likely that you want elements 1–6 to be in the same stack. It might
be necessary to make changes in your model to achieve this. You can review the
partitioning of the continuum shell elements into stacks in the data file by making a
model definition data request.
The continuum shell elements in a stack must satisfy certain criteria; otherwise, Abaqus marks the stack as invalid with respect to computing
CTSHR13 or
CTSHR23. If a stack is marked as
invalid, CTSHR13 or
CTSHR23, if requested, are not
computed and are set to zero for all continuum shell elements in that stack. If a
continuum shell element does not have an elastic material model, if you specify the
transverse shear for any element in the stack, or if the element is specified as rigid,
that stack is marked as invalid. A stack is also marked as invalid if the normal of any
element in a stack is not within 10° of the average normal for the stack. In addition,
if a continuum shell element is removed during the analysis, the stack to which the
element belongs is marked as invalid until the element is reactivated.
There are several other certain restrictions on
CTSHR13 and
CTSHR23.
CTSHR13 and
CTSHR23 are not available in any
continuum shell element with a multi-layer composite material definition. However,
having a multi-layer composite element in the stack does not invalidate the stack. For
the purposes of computing CTSHR13 and
CTSHR23, a maximum of 500 continuum
shell elements can be put in any individual stack. If more than 500 continuum shell
elements are stacked on top of each other, Abaqus issues a warning message during input file preprocessing, and
CTSHR13 and
CTSHR23 are not computed and are set
to zero for all continuum shell elements in the model.
CTSHR13 and
CTSHR23 are not available if element
operations are run in parallel (see Parallel Execution in Abaqus/Standard).
CTSHR13 or
CTSHR23 are currently available only
for static and direct-integration dynamic analyses.
An example using CTSHR13 and
CTSHR23 to estimate the transverse
shear stress distribution in stacked continuum shells can be found in Composite shells in cylindrical bending.