The instantaneous and long-term behaviors provide a check on the Abaqus results. The instantaneous and long-term axial displacements of the rod tip can be
calculated as follows:
These values agree well with the
Abaqus results. Similarly, the instantaneous and long-term values of the Poisson's ratio can
also be calculated exactly:
The Poisson's ratio can be extracted from the
Abaqus results by taking the ratio of the lateral strain to the axial strain at
0.001 and
50:
Since this is an applied stress problem, obtaining the exact solution for the entire time
period of the analysis requires inverting the original constitutive integral equation
defining uniaxial stress in terms of uniaxial strain. To perform this inversion, we use the
following relation (Pipkin, 1972) between the time-dependent relaxation modulus,
, and the time-dependent creep compliance,
:
Differentiation of this relation with respect to t yields
With the previously used expression for
this takes the form
Differentiating this expression once more provides
Multiplying this equation by
and adding it to the previous equation yields the differential equation
With the introduction of the creep time constant
this can be written as:
The general solution to this differential equation is
where the coefficient
C is defined by the initial condition
, which yields
For this problem the stress
is a constant, so that
From the values given above for
,
and
, as well as the fact that
0.689 MPa (100 psi),
becomes
From this equation, it is evident that the effective time constant for the problem is
dramatically different (by a factor of 10 in this case), depending upon whether the loading
is applied force or applied displacement. Figure 2 is a time history plot of
as predicted by the above equation and as calculated by Abaqus. The plot shows acceptable agreement between the Abaqus results and the exact solution. Closer agreement can be obtained by using a smaller
tolerance value for the maximum difference in the creep strain increment over a time
increment.
The solution obtained with the large-strain formulation differs negligibly from the
small-strain solution. Abaqus automatically converts frequency domain data into a time domain Prony series
representation. The analysis results using Prony parameters calibrated from tabulated
frequency-dependent moduli data are in good agreement with the analyses using time domain
data directly.