is generally used to estimate the critical (bifurcation) load of “stiff” structures;
is a linear perturbation procedure;
can be the first step in an analysis of an unloaded structure, or it can be performed
after the structure has been preloaded—if the structure has been preloaded, the buckling
load from the preloaded state is calculated;
can be used in the investigation of the imperfection sensitivity of a structure;
works only with symmetric matrices (hence, unsymmetric stiffness contributions such as
the load stiffness associated with follower loads are symmetrized); and
cannot be used in a model containing substructures.
In an eigenvalue buckling problem we look for the loads for which the model stiffness
matrix becomes singular, so that the problem
has nontrivial solutions. is the tangent stiffness matrix when the loads are applied, and the are nontrivial displacement solutions. The applied loads can consist of
pressures, concentrated forces, nonzero prescribed displacements, and/or thermal loading.
Eigenvalue buckling is generally used to estimate the critical buckling loads of stiff
structures (classical eigenvalue buckling). Stiff structures carry their design loads
primarily by axial or membrane action, rather than by bending action. Their response usually
involves very little deformation prior to buckling. A simple example of a stiff structure is
the Euler column, which responds very stiffly to a compressive axial load until a critical
load is reached, when it bends suddenly and exhibits a much lower stiffness. However, even
when the response of a structure is nonlinear before collapse, a general eigenvalue buckling
analysis can provide useful estimates of collapse mode shapes.
The Base State
The buckling loads are calculated relative to the base state of the structure. If the
eigenvalue buckling procedure is the first step in an analysis, the initial conditions
form the base state; otherwise, the base state is the current state of the model at the
end of the last general analysis step (see General and Perturbation Procedures).
Therefore, the base state can include preloads (“dead” loads), . The preloads are often zero in classical eigenvalue buckling problems.
If geometric nonlinearity was included in the general analysis steps prior to the
eigenvalue buckling analysis (see General and Perturbation Procedures), the base
state geometry is the deformed geometry at the end of the last general analysis step. If
geometric nonlinearity was omitted, the base state geometry is the original configuration
of the body.
The Eigenvalue Problem
An incremental loading pattern, , is defined in the eigenvalue buckling prediction step. The magnitude of
this loading is not important; it will be scaled by the load multipliers, , found in the eigenvalue problem:
where
is the stiffness matrix corresponding to the base state, which includes the effects
of the preloads, (if any);
is the differential initial stress and load stiffness matrix due to the incremental
loading pattern, ;
are the eigenvalues;
are the buckling mode shapes (eigenvectors);
M and N
refer to degrees of freedom M and N of the
whole model; and
i
refers to the ith buckling mode.
The critical buckling loads are then . Normally, the lowest value of is of interest. The preload pattern, , and perturbation load pattern, , may be different. For example, might be thermal loading caused by temperature changes, while is caused by application of pressure.
The buckling mode shapes, , are normalized vectors and do not represent actual magnitudes of
deformation at critical load. They are normalized so that the maximum displacement component
is 1.0. If all displacement components are zero, the maximum rotation component is
normalized to 1.0. These buckling mode shapes are often the most useful outcome of the
eigenvalue analysis, since they predict the likely failure mode of the structure.
Abaqus/Standard can extract eigenvalues and eigenvectors for symmetric matrices only; therefore, and are symmetrized. If the matrices have significant unsymmetric parts, the
eigenproblem may not be exactly what you expected to solve.
Selecting the Eigenvalue Extraction Method
Abaqus/Standard offers the Lanczos and the subspace iteration eigenvalue extraction methods. The
Lanczos method is generally faster when a large number of eigenmodes is required for a
system with many degrees of freedom. The subspace iteration method may be faster when only
a few (less than 20) eigenmodes are needed.
By default, the subspace iteration eigensolver is employed. You can use subspace
iteration and the Lanczos solver for different steps in the same analysis; there is no
requirement that you use the same eigensolver for all appropriate steps.
For both eigensolvers you specify the desired number of eigenvalues; Abaqus/Standard chooses a suitable number of vectors for the subspace iteration procedure or a suitable
block size for the Lanczos method (although you can override this choice, if needed).
Significant overestimation of the actual number of eigenvalues can create very large
files. If the actual number of eigenvalues is underestimated, Abaqus/Standard issues a corresponding warning message.
In general, the block size for the Lanczos method should be as large as the largest
expected multiplicity of eigenvalues (that is, the largest number of modes with the same
eigenvalue). A block size larger than 10 is not recommended. If the number of eigenvalues
requested is n, the default block size is the minimum of (7,
n). The number of block Lanczos steps is usually determined
by Abaqus/Standard, but you can change it when you define the eigenvalue buckling prediction step. In
general, if a particular type of eigenproblem converges slowly, providing more block
Lanczos steps will reduce the analysis cost. However, if you know that a particular type
of problem converges quickly, providing fewer block Lanczos steps will reduce the amount
of in-core memory used. If the number of eigenvalues requested is
n, the default is
Block size
n ≤ 10
n > 10
1
40
70
2
40
60
3
30
60
≥ 4
30
30
If you use the subspace iteration technique, you can also specify the maximum eigenvalue
of interest; Abaqus/Standard extracts eigenvalues until either the requested number of eigenvalues has been
extracted or the last eigenvalue extracted exceeds the maximum eigenvalue of interest.
If you use the Lanczos eigensolver, you can also specify the minimum and/or maximum
eigenvalues of interest; Abaqus/Standard extracts eigenvalues until either the requested number of eigenvalues has been
extracted in the given range or all the eigenvalues in the given range have been
extracted.
Input File Usage
Use the following option to perform an eigenvalue buckling analysis using the
subspace iteration method:
A model containing contact pairs or contact elements.
A model that has been preloaded above the bifurcation (buckling) load.
A model that has rigid body modes.
In such cases Abaqus/Standard will issue an error message and terminate the analysis.
Order of Calculation and Formation of the Stiffness Matrices
In an eigenvalue buckling prediction step Abaqus/Standard first does a static perturbation analysis to determine the incremental stresses, , due to . If the base state did not include geometric nonlinearity, the stiffness
matrix used in this static perturbation analysis is the tangent elastic stiffness. If the
base state did include geometric nonlinearity, initial stress and load stiffness terms
(due to the preload, ) are included. The stiffness matrix corresponding to and is then formed.
In the eigenvalue extraction portion of the buckling step, the stiffness matrix corresponding to the base state geometry is formed. Initial stress and
the load stiffness terms due to the preload, , are always included regardless of whether or not geometric nonlinearity
is included and are calculated based on the geometry of the base state.
When forming the stiffness matrices and , all contact conditions are fixed in the base state.
Buckling Modes with Closely Spaced Eigenvalues
Some structures have many buckling modes with closely spaced eigenvalues, which can cause
numerical problems. In these cases it often helps to apply enough preload, , to load the structure to just below the buckling load before performing
the eigenvalue extraction.
If —where is a scalar constant and the structure is “stiff” and elastic—and if the
problem is linear, the structural stiffness changes to and the buckling loads are given by . The process is equivalent to a dynamic eigenfrequency extraction with
shift . The structure should not be preloaded above the buckling load. In that
case the subspace iteration process may fail to converge or produce incorrect results; the
Lanczos eigensolver cannot be used (as discussed earlier).
In many cases a series of closely spaced eigenvalues indicates that the structure is
imperfection sensitive. An eigenvalue buckling analysis will not give accurate predictions
of the buckling load for imperfection-sensitive structures; the static Riks procedure
should be used instead (see Unstable Collapse and Postbuckling Analysis).
Understanding Negative Eigenvalues
Sometimes, negative eigenvalues are reported in an eigenvalue buckling analysis. In most
cases such negative eigenvalues indicate that the structure would buckle if the load were
applied in the opposite direction. A classical example is a plate under shear loading; the
plate will buckle at the same value for positive and negative applied shear load. Buckling
under reverse loading can also occur in situations where it may not be expected. For
example, a pressure vessel under external pressure may exhibit a negative eigenvalue
(buckling under internal pressure) due to local buckling of a stiffener. Such “physical”
negative buckling modes are usually readily understood once they are displayed and can
usually be avoided by applying a preload before the buckling analysis.
Negative eigenvalues sometimes correspond to buckling modes that cannot be understood
readily in terms of physical behavior, particularly if a preload is applied that causes
significant geometric nonlinearity. In this case a geometrically nonlinear load-displacement
analysis should be performed (Unstable Collapse and Postbuckling Analysis).
Including Large Geometry Changes in a Buckling Analysis
Because buckling analysis is usually done for “stiff” structures, it is not usually
necessary to include the effects of geometry change in establishing equilibrium for the base
state. However, if significant geometry change is involved in the base state and this effect
is considered to be important, it can be included by specifying that geometric nonlinearity
should be considered for the base state step (see General and Perturbation Procedures). In such cases it is probably more realistic to perform a geometrically nonlinear
load-displacement analysis (Riks analysis) to determine the collapse loads, especially for
imperfection-sensitive structures.
While large deformation can be included in the preload, the eigenvalue buckling theory
relies on there being little geometric change due to the “live” buckling load, . If the live load produces significant geometric change, a nonlinear
collapse (Riks) analysis must be used. The total buckling load predicted by the eigenvalue
analysis, , may be a good estimate for the limit load in the nonlinear buckling
analysis. The Riks method is described in Unstable Collapse and Postbuckling Analysis.
Initial Conditions
The initial values of quantities such as stress, temperature, field variables, and
solution-dependent variables can be specified for an eigenvalue buckling analysis. If the
buckling step is the first step in the analysis, these initial conditions form the base
state of the structure. Initial Conditions describes all of
the available initial conditions.
Boundary Conditions
Boundary conditions can be applied to any of the displacement or rotation degrees of
freedom (1–6) or to warping degree of freedom 7 in open-section beam elements (Boundary Conditions). A nonzero
prescribed boundary condition in a general analysis step preceding the eigenvalue buckling
analysis can be used to preload the structure. Nonzero boundary conditions prescribed in an
eigenvalue buckling step will contribute to the incremental stress and, thus, will contribute to the differential initial stress stiffness.
When prescribing nonzero boundary conditions, you must interpret the resulting eigenproblem
carefully. Nonzero prescribed boundary conditions will be treated as constraints (i.e., as
if they were fixed) during the eigenvalue extraction. Therefore, unless the prescribed
boundary conditions are removed for the eigenvalue extraction by specifying buckling mode
boundary conditions (see the discussion below), the mode shapes may be altered by these
boundary conditions.
Amplitude definitions (Amplitude Curves) cannot be used
to vary the magnitudes of prescribed boundary conditions during an eigenvalue buckling
analysis.
You can define perturbation load and buckling mode boundary conditions in an eigenvalue
buckling prediction step.
Input File Usage
Use either of the following two options to define perturbation load boundary
conditions:
The
OP=NEW
parameter is required when you define buckling mode boundary conditions in an eigenvalue
buckling prediction step; however, the perturbation load boundary conditions in the step
can use either
OP=NEW
or
OP=MOD.
Abaqus/CAE Usage
Load module: Create Boundary Condition: choose
Mechanical for the Category and
Symmetry/Antisymmetry/Encastre for the Types for Selected
Step: select region: toggle on Stress perturbation only
to define a perturbation load boundary condition; toggle on Buckling mode
calculation only to define a buckling mode boundary condition; toggle on
Stress perturbation and buckling mode calculation to define both
types of boundary conditions
Combining Boundary Conditions
The buckling mode shapes depend on the stresses in the base state as well as the
incremental stresses due to the perturbation loading in the buckling step. These stresses
are influenced by the boundary conditions used in each step. In a general eigenvalue
buckling analysis the following types of boundary conditions can influence the stresses:
The boundary conditions in the base state.
The boundary conditions used to calculate the linear perturbation stresses, . These boundary conditions will be:
the perturbation load boundary conditions specified in the eigenvalue buckling
step; or
the base-state boundary conditions if no perturbation load boundary conditions
are specified in the eigenvalue buckling step; or
the buckling mode boundary conditions if neither perturbation load boundary
conditions nor base-state boundary conditions exist.
The boundary conditions used for the eigenvalue extraction. These boundary conditions
will be:
the buckling mode boundary conditions; or
the perturbation load boundary conditions if buckling mode boundary conditions
are not specified in the eigenvalue buckling step; or
the base-state boundary conditions if no boundary condition definition is used in
the eigenvalue buckling step.
Table 1 summarizes the use of boundary conditions during an eigenvalue buckling step. When
buckling mode boundary conditions are specified, all boundary
conditions to be imposed during eigenvalue extraction must be specified.
Buckling of Symmetric Structures
The buckling mode shapes of symmetric structures subjected to symmetric loadings are
either symmetric or antisymmetric. In such cases it is often more efficient to model only
part of the structure and then perform the buckling analysis twice for each symmetry
plane: once with symmetric boundary conditions and once with antisymmetric boundary
conditions.
The live load pattern is usually symmetric, so symmetric boundary conditions are required
for the calculation of the perturbation stresses used in the formation of the initial
stress stiffness matrix. The boundary conditions must be switched to antisymmetric for the
eigenvalue extraction to obtain the antisymmetric modes. Buckling of a cylindrical shell under uniform axial pressure illustrates
such a case.
If the model includes more than one symmetry plane, it may be necessary to study all
permutations of symmetric and antisymmetric boundary conditions for each symmetry plane.
Table 1. Boundary conditions in effect during the different portions of an eigenvalue
buckling analysis.
User-defined
boundary conditions
Boundary conditions
used by Abaqus
Base state
Eigenvalue buckling prediction step
Linear perturbation
Eigenvalue extraction
B
0
B
B
0
1
1
1
0
2
2
2
B
1
1
1
B
2
B
2
0
1, 2
1
2
B
1, 2
1
2
B = base-state
boundary conditions; 0 = no boundary conditions specified
1 = perturbation
load boundary conditions
2 = buckling mode
boundary conditions
Asymmetric Buckling of Axisymmetric Structures
Axisymmetric structures subjected to compressive loading often collapse in
nonaxisymmetric modes. These modes cannot be found with purely axisymmetric modeling
such as that provided by shell elements
SAX1 and
SAX2 (Axisymmetric Shell Element Library) or
continuum elements CAX4 or
CAX8 (Axisymmetric Solid Element Library). Such
analyses must be done with three-dimensional shell or continuum elements.
Loads
The following types of loading can be prescribed in an eigenvalue buckling analysis:
Concentrated nodal forces can be applied to the displacement degrees of freedom (1–6);
see Concentrated Loads.
Distributed pressure forces or body forces can be applied; see Distributed Loads. The
distributed load types available with particular elements are described in Abaqus Elements Guide.
The load stiffness can have a significant effect on the critical buckling load; therefore,
Abaqus/Standard will take the load stiffness due to preloads into account when solving the eigenvalue
buckling problem. It is important that the structure not be preloaded above the critical
buckling load.
Any load applied during the eigenvalue buckling analysis is called a “live” load. This
incremental load, , describes the load pattern for which buckling sensitivity is being
investigated; its magnitude is not important. This incremental loading definition represents
linear perturbation loads, as described in About Loads.
Follower forces (such as concentrated loads assumed to rotate with the nodal rotation or
pressure loads) lead to an unsymmetric load stiffness. Since eigenvalue extraction in Abaqus/Standard can be performed only on symmetric matrices, eigenvalue analysis with follower loads may
not yield correct results.
Amplitude definitions cannot be used during an eigenvalue buckling analysis. About Loads describes all of
the available loads.
Prescribed boundary conditions can also be used to load the structure in an eigenvalue
buckling analysis, as discussed earlier.
Predefined Fields
In an eigenvalue buckling prediction step, nodal temperatures can be specified (see Predefined Fields). The specified
temperatures can cause thermal strain during the static perturbation analysis if a thermal
expansion coefficient is given for the material (see Computing Thermal Strains in Linear Perturbation Steps), and incremental stresses will be generated. Hence, Abaqus/Standard can analyze buckling due to thermal stress. The specified temperature will not affect
temperature-dependent material properties during the eigenvalue buckling prediction step;
the material properties are based on the temperature in the base state. Amplitude
definitions cannot be used to vary the magnitudes of prescribed temperatures during an
eigenvalue buckling analysis.
Material Options
During an eigenvalue buckling analysis, the model's response is defined by its linear
elastic stiffness in the base state. All nonlinear and/or inelastic material properties, as
well as effects involving time or strain rate, are ignored during an eigenvalue buckling
analysis. In classical eigenvalue buckling the response in the base state is also linear.
If temperature-dependent elastic properties are used, the eigenvalue buckling analysis will
not account for changes in the stiffness matrix due to temperature changes. The material
properties of the base state will be used.
Acoustic properties, thermal properties (except for thermal expansion), mass diffusion
properties, electrical properties, and pore fluid flow properties are not active during an
eigenvalue buckling analysis.
Elements
Any of the stress/displacement elements in Abaqus/Standard (including those with temperature or pressure degrees of freedom) can be used in an
eigenvalue buckling analysis, with the exception that hybrid and contact elements cannot be
used with the Lanczos eigensolver (as discussed earlier). See Choosing the Appropriate Element for an Analysis Type.
Output
The values of the eigenvalues, , will be listed in the printed output file. If output of stresses,
strains, reaction forces, etc. is requested, this information will be printed for each
eigenvalue; these quantities are perturbation values and represent mode shapes, not absolute
values. All of the output variable identifiers are outlined in Abaqus/Standard Output Variable Identifiers.
Buckling mode shapes can be plotted in the Visualization module of Abaqus/CAE.
Input File Template
The following template describes a very general eigenvalue buckling problem, where as
many eigenvalue buckling prediction steps as needed can be specified.
Symmetric boundary conditions are specified in the model definition part of the Abaqus/Standard input and, therefore, belong to the base state (see General and Perturbation Procedures). In the first buckling step Abaqus/Standard uses the base-state boundary conditions to solve for the perturbation stresses as well as
for the eigenvalue extraction.
In the second buckling step the boundary conditions for the base state, the initial
stress calculation, and the eigenvalue extraction are all different. Abaqus/Standard uses the specified symmetry boundary conditions to solve for the perturbation stresses
but uses the specified antisymmetry boundary conditions for the eigenvalue
extraction.
HEADING
…
BOUNDARYData lines to specify zero-valued boundary conditions contributing to the base state
**
STEP, NLGEOMThe load stiffness terms will be included in the eigenvalue buckling stepssince the NLGEOM parameter is used in this (optional) preload stepSTATICData line to control incrementationBOUNDARYData lines to specify nonzero boundary conditions (dead loads)CLOAD and/or DLOAD and/or TEMPERATUREData lines to specify dead loads,
END STEP
**
STEPBUCKLEData line to request the desired number of symmetric modesCLOAD and/or DLOAD and/or TEMPERATUREData lines to specify perturbation loading,
END STEP
**
STEPBUCKLEData line to request the desired number of antisymmetric modesCLOAD and/or DLOAD and/or TEMPERATUREData lines to specify perturbation loading,
BOUNDARY, LOAD CASE=1Data lines to specify all boundary conditions for perturbation loadingBOUNDARY, LOAD CASE=2, OP=NEWData lines to specify all antisymmetric boundary conditions for eigenvalue extractionEND STEP