*SUBSTRUCTURE LOAD CASE

Begin the definition of a substructure load case.

This option is used to begin the definition of a substructure load case for the substructure currently being generated. It can be used only in a SUBSTRUCTURE GENERATE analysis.

This page discusses:

See Also
*SLOAD
In Other Guides
Generating Substructures

ProductsAbaqus/StandardAbaqus/CAE

TypeHistory data

LevelThis option is not supported in a model defined in terms of an assembly of part instances.

Required parameters

NAME

Set this parameter equal to a label that is used to refer to the load case in SLOAD option specifications when applying loads to the substructure during an analysis.

Required parameter for substructure load cases that include nodal pressure loading

GENERATE

Include this parameter to generate multiple substructure load cases.

This parameter applies only to a load case definition that refers to the nodal pressure distributed load type label (NP) in the DSLOAD option.

Nodal pressure substructure load cases are generated for each node of the referenced surface. The label that is used to refer to the individual load case in SLOAD option specifications is formatted using the specified load case name, the referenced surface name, and the node number as follows:

name-surface_name-node_number

To define the loads

Enter any mechanical loading options (Concentrated Loads and Distributed Loads) or thermal loading options (Thermal Loads) to define the loads forming the load case. Specify a magnitude for each load. This magnitude is scaled by a magnitude and amplitude reference specified in the SLOAD option. The load case definition continues until an option is encountered that is not one of the loading options. If boundary conditions are included in a SUBSTRUCTURE LOAD CASE, they are always active, even if the SLOAD option is not used.