You can write variables associated with surfaces in contact, coupled
thermal-electrical-structural (Abaqus/Standard only), coupled temperature-displacement (Abaqus/Standard only), coupled thermal-electrical, and crack propagation problems to the output database.
Multiple output requests can be used to customize requests among interactions,
surfaces, or node sets.
In Abaqus/Standard contact history output cannot be saved in a linear perturbation step with frequency
extraction.
Displacement nodal output is generated automatically in Abaqus/Explicit when requesting surface output.
Selecting the Surface Output Variables
The surface variables that can be written to the output database are listed in Surface Variables (Abaqus/Standard) and Surface Variables (Abaqus/Explicit).
Step module: field or history output request editor: Select from list below
Limiting the Extent of a Surface Output Request in Abaqus/Standard
Output requests apply to general contact and all contact pair interactions in a model by
default in Abaqus/Standard. Options to limit an output request to certain interactions are discussed below.
Limiting Output to a Node Set in Abaqus/Standard
You can limit a surface output request to apply to a subset of surface nodes involved in
contact pairs or general contact in Abaqus/Standard.
Step module: field or history output request editor: Domain:Interaction:contact_interaction_name
Limiting Output for Contact Pairs Based on Secondary and Main Surface Names in Abaqus/Standard
You can limit output to certain contact pairs based on surface names. If you specify both
the secondary and main surface names, the output request is limited to a specific contact
pair. If you specify the secondary surface but not the main surface, output is written for
all contact pairs that involve the specified secondary surface. If you also specify a node
set, the applicability of an output request is further limited (that is, the output
request will generate output only for certain nodes of a certain contact pair (or pairs).
Output requests with a specific secondary and/or main surface role specified will not
generate output for general contact.
You cannot limit surface field output for cracked surfaces in enriched elements in
Abaqus/CAE.
Limiting the Extent of a Surface Field Output Request in Abaqus/Explicit
Field output requests apply to general contact and all contact pair interactions in a model
by default in Abaqus/Explicit. Options to limit a surface field output request to certain interactions are discussed
below.
Limiting Surface Field Output to a Contact Pair Set in Abaqus/Explicit
In Abaqus/Explicit you can select the contact pairs for which surface field output is desired. Surface
output is contact pair-specific, so that contact output for a particular surface involved
in a selected contact pair will include only the contributions from that contact pair if
the surface is involved in multiple contact pairs. Surface output is available only for
discrete (node-based or element-based) surfaces; it is not available for any analytical
surfaces within a contact pair.
Input File Usage
Use the following option to request surface field output for a particular contact
pair set:
Step module: field output request editor: Domain:Interaction:contact_interaction_name
Limiting Surface Field Output to General Contact in Abaqus/Explicit
You can limit surface field output requests to apply only to general contact in Abaqus/Explicit, but you cannot further limit this output to a subset of the general contact domain.
You cannot limit surface field output to general contact in Abaqus/CAE.
Limiting Surface Field Output to a Single Surface in Abaqus/Explicit
You can limit surface field output requests to a single surface in the general contact
domain in Abaqus/Explicit. The contact output for the specified surface will include all the contributions from
other contact surfaces interacting with the surface.
You cannot limit a single surface output to general contact in Abaqus/CAE.
Limiting Surface Field Output to Pairwise Surfaces in Abaqus/Explicit
You can specify a pair of surfaces in the general contact domain in Abaqus/Explicit for which the interactions on one surface due to the contact with another surface will
be output. This type of output cannot be used for surfaces involving Eulerian regions. The
following contact output variables are not supported with this type of output:
CDISP,
CTANDIR,
CDISPR,
CSLIPR,
CORIENT,
CFRICWORK, and
CSTATUS.
Input File Usage
CONTACT OUTPUT, SURFACE=first_surface_name,
SECOND SURFACE=second_surface_name
Abaqus/CAE Usage
You cannot limit pairwise surface output to general contact in Abaqus/CAE.
Specifying Surface History Output Regions in Abaqus/Explicit
You must specify an interaction to which a surface history output request applies with one
of the methods discussed below.
Specifying Surface History Output by Contact Pair Set in Abaqus/Explicit
In Abaqus/Explicit you can select the contact pairs for which surface history output is desired. Surface
output is contact pair-specific, so that contact output for a particular surface involved
in a selected contact pair will include only the contributions from that contact pair if
the surface is involved in multiple contact pairs. Surface output is available only for
discrete (node-based or element-based) surfaces; it is not available for any analytical
surfaces within a contact pair.
Input File Usage
Use the following option to request surface history output for a particular contact
pair:
Step module: history output request editor: Domain:Interaction:contact_interaction_name
Specifying Whole Surface History Output in Abaqus/Explicit
You can specify a surface in the general contact domain for which whole surface contact
force resultants will be output. Whole surface contact force resultants for a surface in
the general contact domain are available only as history output.
Step module: history output request editor: Domain: General contact surface:surface_name
Specifying Pairwise Surface History Output in Abaqus/Explicit
You can specify a pair of surfaces in the general contact domain for which the resultant
contact forces on one surface due to the contact with another surface will be output. The
contact force resultants in this case consider only the contact interactions between the
two specified surfaces. This type of output cannot be requested for surfaces involving
Eulerian regions.
Input File Usage
CONTACT OUTPUT, SURFACE=first_surface_name,
SECOND SURFACE=second_surface_name
Abaqus/CAE Usage
You cannot request surface history output for a pair of surfaces in Abaqus/CAE.
Specifying Surface History Output by Fastened Node Set in Abaqus/Explicit
You can select a fastened node set for which bond history output is desired:
Input File Usage
Use the following option to request surface history output for a particular fastened
node set:
You can request the preselected, procedure-specific surface output variables described in
Preselected Output Requests. In this case you can specify additional variables as part of the output
request.
Alternatively, you can request all surface variables applicable to the current procedure.
In this case any additional variables you specify are ignored.
Input File Usage
Use the following option to request the preselected surface output variables: