Modeling Multiscale Materials with Deep Material Networks (DMNs)

The DMN material model:

  • uses deep material networks (DMNs);
  • can be used to model composites with multiscale modeling;
  • can be used to model both linear and nonlinear behavior of fiber-reinforced composites; and
  • is available as a special-purpose built-in user-defined material.

This page discusses:

See Also
Mean-Field Homogenization
In Other Guides
About Table Collections, Parameter Tables, and Property Tables

Products Abaqus/Standard

Deep material network (DMN) is a data-driven surrogate model for heterogeneous materials (Liu and Wu, 2019). Based on linear elastic training data generated by high-fidelity computational homogenization (such as FE-RVE simulation), DMN is capable of predicting their elastic and inelastic behaviors with high accuracy. DMN learns the morphological characterizations of the microstructure by the homogenized effective stiffness tensor C ¯ and the stiffness of the constituents C 1 and C 2 . The effective stiffness tensor is usually computed using a high-fidelity homogenization method such as the FE-RVE method. The coefficients of DMN are computed by minimizing the difference between the DMN and the FE-RVE predictions, as shown in Figure 1.

Figure 1. Training of DMN.

The DMN model is available as built-in user-defined material options. To activate the capability, you must specify a specific material user type label in the material definition:

  • Use "DMN_UD" if the composite is reinforced with unidirectional fibers.
  • Use "DMN_CHOPPED" if the composite is reinforced with dispersed short fibers.

    In this case, the dispersion of the fiber is defined with a second-order orientation tensor.

Abaqus internally creates state variables used for this material model. You should not define any solution-dependent state variables because they are reserved for specific output variables.

A dedicated collection of parameter and property tables is available to include all definitions required to use the model. You can use the abaqus fetch utility to obtain the file containing the type definitions for the parameter and property tables used by the DMN model:

abaqus fetch job=ABQ_DMN_types.inp

Input File Usage

Use the following options to start the definition of a unidirectional fiber-reinforced composite based on built-in user-defined material options:

INCLUDE, INPUT="ABQ_DMN_types.inp"
MATERIAL, USER TYPE="DMN_UD"
USER MATERIAL, CONSTANTS=0

Use the following options to start the definition of a short fiber-reinforced composite based on built-in user-defined material options:

INCLUDE, INPUT="ABQ_DMN_types.inp"
MATERIAL, USER TYPE="DMN_CHOPPED"
USER MATERIAL, CONSTANTS=0