*Heading Mullins Effect, Definition=Exponential, Compressible Hyperelasticity, Yeoh Model Cyclic Uniaxial Tension, 3D element User Subroutine required for this input file mmecdo3cut_user.f ** ** ** PARTS ** *Part, name=PART-1 *End Part ** ** ASSEMBLY ** *Assembly, name=Assembly ** *Instance, name=PART-1-1, part=PART-1 *Node 1, 0., 0., 0. 2, 1., 0., 0. 3, 1., 1., 0. 4, 0., 1., 0. 5, 0., 0., 1. 6, 1., 0., 1. 7, 1., 1., 1. 8, 0., 1., 1. *Element, type=C3D8RH 1, 1, 2, 3, 4, 5, 6, 7, 8 *Elset, elset=ONE 1, ** Region: (Section-1-ONE:ONE) *Elset, elset=_I1, internal 1, ** Section: Section-1-ONE *Solid Section, elset=_I1, material=YEOH-MAT, controls=CONTR 1., *Hourglass Stiffness 0.5,,,, *End Instance *Nset, nset=ALL, instance=PART-1-1, generate 1, 8, 1 *Nset, nset=FACE1, instance=PART-1-1, generate 1, 4, 1 *Nset, nset=FACE2, instance=PART-1-1, generate 5, 8, 1 *Nset, nset=FACE3, instance=PART-1-1 1, 2, 5, 6 *Nset, nset=FACE4, instance=PART-1-1 2, 3, 6, 7 *Nset, nset=FACE5, instance=PART-1-1 3, 4, 7, 8 *Nset, nset=FACE6, instance=PART-1-1 1, 4, 5, 8 *Nset, nset=SET, instance=PART-1-1 6,7,3 *NSET, NSET=TWO, instance=PART-1-1 2, *EQUATION 2 SET,1,1, PART-1-1.2,1,-1 *End Assembly ** *Section Controls, hourglass=stiffness, name=CONTR ** ** MATERIALS ** *Material, name=YEOH-MAT *Hyperelastic, user, type=COMPRESSIBLE, properties=4 1.326, -0.326, 0.1319, 0.000725 *Mullins effect, definition=Exponential 0.5,100, 1.5 ** ---------------------------------------------------------------- ** ** STEP: Step-1 ** *Step, name=Step-1, nlgeom, inc=20 UNIAXIAL TENSION *Static, direct 1., 20., ** ** BOUNDARY CONDITIONS ** *Boundary FACE1, 3, 3 FACE3, 2, 2 FACE6, 1, 1 TWO, 1, 1, 2. ** ** HISTORY OUTPUT ** *Output, history, frequency=10 ** *Element Output, elset=PART-1-1.ONE SENER, S, DMENER *Node Output, nset=TWO U,RF *End Step ** ---------------------------------------------------------------- ** ** STEP: Step-2 ** *Step, name=Step-2, nlgeom *Static, direct 1., 20., ** ** BOUNDARY CONDITIONS ** *Boundary, op=NEW FACE1, 3, 3 FACE3, 2, 2 FACE6, 1, 1 TWO, 1, 1 ** *End Step ** ---------------------------------------------------------------- ** ** STEP: Step-3 ** *Step, name=Step-3, nlgeom *Static, direct 1., 20., ** ** BOUNDARY CONDITIONS ** *Boundary, op=NEW FACE1, 3, 3 FACE3, 2, 2 FACE6, 1, 1 TWO, 1, 1, 3. *End Step ** ---------------------------------------------------------------- ** ** STEP: Step-4 ** *Step, name=Step-4, nlgeom *Static, direct 1., 20., ** ** BOUNDARY CONDITIONS ** *Boundary, op=NEW FACE1, 3, 3 FACE3, 2, 2 FACE6, 1, 1 TWO, 1, 1 *End Step