Defining the material and section properties

The next step in creating the model involves defining and assigning material and section properties to the part. Each region of a deformable body must refer to a section property, which includes the material definition. In this model you will create a single linear elastic material with a Young's modulus E = 200 GPa and Poisson's ratio ν = 0.3.

This task shows you how to:

Define material properties

  1. In the Model Tree, double-click the Materials container to create a new material definition.
  2. In the material editor that appears, name the material Steel and select MechanicalElasticityElastic. Enter 200.0E9 for the Young's Modulus and 0.3 for the Poisson's Ratio. Click OK.

Define section properties

  1. In the Model Tree, double-click the Sections container to create a new section definition. Accept the default solid, homogeneous section type; and name the section LugSection. Click Continue.
  2. In the Edit Section dialog box that appears, accept Steel as the material and click OK.

Assign section properties

  1. In the Model Tree, expand the Lug item underneath the Parts container and double-click Section Assignments in the list of part attributes that appears.
  2. Select the entire part as the region to which the section will be assigned by clicking on it. When the part is highlighted, click Done in the prompt area.
  3. In the Edit Section Assignment dialog box that appears, accept LugSection as the section definition, and click OK.