Abaqus/CAE assigns a default top-down meshing technique to each meshable region of your model based on the geometry of the region and the current element shape selection for that region. Abaqus/CAE uses the mesh technique assigned to a region to generate a mesh for the region. You can use the Mesh Controls dialog box to select an alternate meshing technique.
Abaqus/CAE displays prompts
in the prompt area to guide you through the procedure.
Tip:
You can also set the meshing technique using the tool, located in the Mesh module toolbox.
Select faces of solid regions to assign mesh controls to boundary faces of solid regions that will be tetrahedral meshed or bottom-up meshed.
If your part or assembly contains more than one region, select those regions whose meshing technique you want to view or modify and press mouse button 2. The selected regions must all have the same dimensionality.
The Mesh Controls dialog box appears.
From the list of Technique options, select the meshing technique of your choice. (Some techniques are available only if they are valid for the selected region.)
Abaqus/CAE selects As is if, in the previous step, you selected multiple regions that have different meshing techniques already assigned to them.
Abaqus/CAE selects Multiple if a change in element shape assignment results in multiple techniques being assigned automatically to the selected regions. For example, suppose the free meshing technique is applied to all the regions of a solid part instance. If you change the element shape assignment of these regions from Tet to Hex or Hex-dominated, Abaqus/CAE automatically changes the meshing technique assigned to each region from the free meshing technique to whatever technique is appropriate for each region; for example, structured meshing for some regions and swept meshing for others.
Note:
The bottom-up meshing technique must be manually assigned to or removed from a region. When you modify the geometry of a region to which the bottom-up meshing technique is assigned, the resulting region or regions will also be assigned the bottom-up meshing technique. You can click Defaults in the Mesh Controls dialog box to assign a top-down technique to a bottom-up region.
While assigning mesh controls to faces of a region, Abaqus/CAE color codes the faces according to the mesh technique that will be used on the faces. The face colors may not be the same as the color for the region. For example, the faces of a bottom-up region will appear pink by default since they are free meshed. If you assign the structured mesh technique to some faces, they will be colored green. The solid region color for a bottom-up region is light tan, and the color for a solid region that will be tetrahedral meshed is pink.
Click OK to close the dialog box and to save your mesh technique selection.
The next time you generate a mesh on the selected part instance or region, your selections will be honored.
If the selected region already contains a mesh, you will be prompted to delete the mesh or to cancel the mesh control procedure.
tool, located in the Mesh module toolbox.