*******************************************************
*******************************************************
** This model checks anisotropic friction (see RF)
** and the new output CORIENT
*******************************************************
*******************************************************
*Heading
** Job name: copen Model name: Model-1
** Generated by: Abaqus/CAE 2016
*Preprint, echo=NO, model=YES, history=YES, contact=YES
** ----------------------------------------------------------------
** 
** PART INSTANCE: Part-1-1
** 
*Node
      1,           5.,           5.,           5.
      2,           5.,           0.,           5.
      3,           5.,           5.,           0.
      4,           5.,           0.,           0.
      5,           0.,           5.,           5.
      6,           0.,           0.,           5.
      7,           0.,           5.,           0.
      8,           0.,           0.,           0.
*Node, nset=refNode
     14,          2.5,          2.5,           5.
*Element, type=C3D8R, elset=all1
1, 5, 6, 8, 7, 1, 2, 4, 3
*Nset, nset=Part-1-1_Set-1, generate
 1,  8,  1
*Elset, elset=Part-1-1_Set-1
 1,
*Surface, name=surf_P
all1, S3
*Surface, name=surf1
all1, S5
** Section: Section-1
*Solid Section, elset=Part-1-1_Set-1, material=Material-1
,
*Coupling, constraint name=Constraint-1, ref node=refNode, surface=surf_P
*Kinematic
** ----------------------------------------------------------------
** 
** PART INSTANCE: Part-2-1
** 
*Node
      9,          30.,          35.,           0.
     10,         -10.,          35.,           0.
     11,          30.,          -15.,           0.
     12,         -10.,          -15.,           0.
     13,         0.,          0.,           0.
*Element, type=S4R, elset=all2
2,  9, 10, 12, 11
*Nset, nset=Part-2-1_Set-1, generate
 9, 12,  1
*Elset, elset=Part-2-1_Set-1
 2,
*Surface, name=surf2
all2, SPOS
** Section: Section-2
*Shell Section, elset=Part-2-1_Set-1, material=Material-1, offset=0.5
1., 5
*RIGID BODY, ELSET=Part-2-1_Set-1, ref = Rigid
*Nset, nset=Rigid
 13
*Nset, nset=Set-2
 1, 2, 5, 6
*Elset, elset=Set-2
 1,
*Amplitude, name=Amp-1, definition=SMOOTH STEP
             0.,              0.,            0.05,              1.
*Amplitude, name=Amp-2, definition=SMOOTH STEP
             0.,              0., 
	     0.1,              1.
*Amplitude, name=Amp-3, definition=SMOOTH STEP
             0.,              3,
	     0.1,              6.
*Orientation, name=ORI_1
0.0, 1.0, 0.0,     1.0, 1.0, 0.0	     
*Orientation, name=ORI_2
0.0, 1.0, 0.0,    -1.0, 1.0, 0.0	     
** 
** MATERIALS
** 
*Material, name=Material-1
*Density
 7.8e-09,
*Elastic
70000., 0.3
** 
** INTERACTION PROPERTIES
** 
*Surface Interaction, name=IntProp-1
** Correspond to mu1=0.3, and mu2=0.1
*Friction, anisotropic  = SURFACE PROPERTY
0.2
**-----------------------------------------------------------`
*Contact
*Contact Inclusions
surf1, surf2
*Contact Property Assignment
surf1, surf2, IntProp-1
*surface property assignment, property=ORIENTATION
surf1, ORI_1,, 0.5
surf2, ORI_2,, 0.5
** ----------------------------------------------------------------
** 
** STEP: Step-1
** 
*Step, name=Step-1, nlgeom=YES
*Dynamic, Explicit
, 0.05
*Bulk Viscosity
0.06, 1.2
** 
** BOUNDARY CONDITIONS
** 
** Name: BC-1 Type: Displacement/Rotation
*Boundary
Rigid, 1, 1
Rigid, 2, 2
Rigid, 3, 3
Rigid, 4, 4
Rigid, 5, 5
Rigid, 6, 6
refNode,4,6
** Name: BC-2 Type: Displacement/Rotation
*CLOAD, amplitude = Amp-1
refNode, 3, -25
** 
** INTERACTIONS
** 
** Interaction: Int-1
** OUTPUT REQUESTS
** 
*Restart, write, number interval=1, time marks=NO
** 
** FIELD OUTPUT: F-Output-1
** 
*Output, field, number interval=5
*Node Output
U
*Element Output, directions=YES
S
*Contact Output
CFORCE,CDISP, CTANDIR, CORIENT
** 
** HISTORY OUTPUT: H-Output-1
** 
*Output, history, variable=PRESELECT
*Output, history,frequency=100
*NODE OUTPUT, nset= Rigid
RF
*NODE OUTPUT, nset= refNode
RF,V
*End Step
** ----------------------------------------------------------------
** 
** STEP: Step-2
** 
*Step, name=Step-2, nlgeom=YES
*Dynamic, Explicit
, 0.1
*Bulk Viscosity
0.06, 1.2
** 
** Name: BC-2 Type: Displacement/Rotation
*Boundary, amplitude=Amp-2
refNode, 1, 1, 3
*End Step
** ----------------------------------------------------------------
** 
** STEP: Step-3
** 
*Step, name=Step-3, nlgeom=YES
*Dynamic, Explicit
, 0.001
*Boundary, op=new
Rigid, 1, 1
Rigid, 2, 2
Rigid, 3, 3
Rigid, 4, 4
Rigid, 5, 5
Rigid, 6, 6
refNode,4,6
** 
*End Step
** ----------------------------------------------------------------
** 
** STEP: Step-4
** 
*Step, name=Step-4, nlgeom=YES
*Dynamic, Explicit
, 0.1
*Bulk Viscosity
0.06, 1.2
** 
** Name: BC-2 Type: Displacement/Rotation
*Boundary, amplitude=Amp-2
refNode, 2, 2, 3
*End Step
** ----------------------------------------------------------------
** 
** STEP: Step-5
** 
*Step, name=Step-5, nlgeom=YES
*Dynamic, Explicit
, 0.001
*Boundary, op=new
Rigid, 1, 1
Rigid, 2, 2
Rigid, 3, 3
Rigid, 4, 4
Rigid, 5, 5
Rigid, 6, 6
refNode,4,6
** 
*End Step
** ----------------------------------------------------------------
** 
** STEP: Step-6
** 
*Step, name=Step-6, nlgeom=YES
*Dynamic, Explicit
, 0.1
*Bulk Viscosity
0.06, 1.2
** 
** Name: BC-2 Type: Displacement/Rotation
*Boundary, amplitude=Amp-3
refNode, 1, 1, 1
refNode, 2, 2, 1
*End Step