*COUPLED TEMPERATURE-DISPLACEMENT

Fully coupled, simultaneous heat transfer and stress analysis.

This option is used to analyze problems where the simultaneous solution of the temperature and stress/displacement fields is necessary.

This page discusses:

See Also
In Other Guides
Fully Coupled Thermal-Stress Analysis
Fully Coupled Thermal-Electrochemical-Structural Analysis
Rate-Dependent Plasticity: Creep and Swelling
Fully Coupled Thermal-Electrochemical-Structural–Pore Pressure Analysis

ProductsAbaqus/StandardAbaqus/CAE

TypeHistory data

LevelStep

Abaqus/CAEStep module

Optional parameters

ADVECTION

This parameter applies only to a coupled thermal-electrochemical-structural–pore pressure analysis. It is valid only when pore pressure is included with electrochemistry.

Set ADVECTION=YES (default) to consider the fluid velocity effects.

Set ADVECTION=NO to ignore the fluid velocity effects.

ALLSDTOL

Include this parameter to indicate that an adaptive automatic damping algorithm will be activated in this step. Set this parameter equal to the maximum allowable ratio of the stabilization energy to the total strain energy. The initial damping factor is specified using the STABILIZE parameter or the FACTOR parameter. This damping factor will then be adjusted through the step based on the convergence history and the value of ALLSDTOL. If this parameter is set equal to zero, the adaptive automatic damping algorithm is not activated; a constant damping factor will be used throughout the step. If this parameter is included without a specified value, the default value is 0.05. If this parameter is omitted but the STABILIZE parameter is included with the default value of dissipated energy fraction, the adaptive automatic damping algorithm will be activated automatically with ALLSDTOL=0.05.

This parameter must be used in conjunction with the STABILIZE parameter (see Solving Nonlinear Problems).

CONTINUE

Set CONTINUE=NO (default) to specify that this step will not carry over the damping factors from the results of the preceding general step. In this case the initial damping factors will be recalculated based on the declared damping intensity and on the solution of the first increment of the step or can be specified directly.

Set CONTINUE=YES to specify that this step will carry over the damping factors from the end of the immediately preceding general step.

This parameter must be used in conjunction with the ALLSDTOL and the STABILIZE parameters.

CREEP

Set CREEP=EXPLICIT to use explicit integration for creep and swelling effects throughout the step, which may sometimes be computationally less expensive. When CREEP=EXPLICIT, the time increment will be limited by the accuracy tolerances (CETOL and DELTMX) and also by the stability limit of the forward difference operator. See Rate-Dependent Plasticity: Creep and Swelling for details on the integration scheme.

Set CREEP=NONE to specify that there is no creep or viscoelastic response occurring during this step even if creep or viscoelastic material properties have been defined.

ELECTRICAL

Include this parameter to model electrical conduction in regions of the model that use thermal-electrical-structural elements.

In this case, Abaqus/Standard solves the heat transfer equations in conjunction with the mechanical equilibrium and the electrical conduction equations.

Omit this parameter to specify that electrical conduction is not modeled in these regions.

ELECTROCHEMICAL

Include this parameter to model electrochemistry in regions of the model that use thermal-electrochemical-structural elements.

In this case, Abaqus/Standard solves the heat transfer equations in conjunction with the mechanical equilibrium and the electrical and electrochemical equations.

Omit this parameter to specify that electrochemistry is not modeled in these regions.

FACTOR

Set this parameter equal to the damping factor to be used in the automatic damping algorithm (see Solving Nonlinear Problems) if the problem is expected to be unstable due to local instabilities and the damping factor calculated by Abaqus/Standard is not suitable. This parameter must be used in conjunction with the STABILIZE parameter and overrides the automatic calculation of the damping factor based on a value of the dissipated energy fraction.

PORE PRESSURE

Include this parameter to model pore pressure–mediated fluid (electrolyte) flow in a porous medium along with the thermal, electrochemical, and structural physics in regions of the model that use thermal-electrochemical-structural–pore pressure elements.

In this case, Abaqus/Standard solves the pore fluid continuity equation fully coupled with the thermal, electrochemical, and structural governing equations.

Omit this parameter if pore fluid continuity is not modeled in these regions.

RATE DEPENDENCE

Set RATE DEPENDENCE=ON (default) to consider the strain rate–dependence when evaluating the yield stress of a material and to consider the slip rate–dependence when evaluating the friction coefficient.

Set RATE DEPENDENCE=OFF to ignore the strain rate–dependence when evaluating the yield stress of a material and to ignore the slip rate–dependence when evaluating the friction coefficient.

STABILIZE

Include this parameter to use automatic stabilization if the problem is expected to be unstable due to local instabilities. Set this parameter equal to the dissipated energy fraction of the automatic damping algorithm (see Solving Nonlinear Problems). If this parameter is omitted, the stabilization algorithm is not activated. If this parameter is included without a specified value, the default value of the dissipated energy fraction is 2 × 10−4 and the adaptive automatic damping algorithm will be activated by default with ALLSDTOL =0.05 in this step; set ALLSDTOL=0 to deactivate the adaptive automatic damping algorithm. If the FACTOR parameter is used, any value of the dissipated energy fraction is overridden by the damping factor.

STEADY STATE

Include this parameter to choose steady-state analysis. If this parameter is omitted, the step is assumed to involve transient response. If this parameter is included, automatic time incrementation will be used.

Optional parameters to control time incrementation in transient analysis

CETOL

This parameter is meaningful only when the material response is time dependent (creep and swelling).

Set this parameter equal to the maximum difference in the creep strain increment calculated from the creep strain rates at the beginning and at the end of the increment, thus controlling the accuracy of the creep integration. The tolerance is sometimes calculated by choosing an acceptable stress error tolerance and dividing by a typical elastic modulus.

If both this parameter and the DELTMX parameter are omitted in a transient analysis, fixed time increments are used, with a constant time increment equal to the initial time increment.

DELTMX

Set this parameter equal to the maximum temperature change allowed within an increment. Abaqus/Standard restricts the time step to ensure that this value is not exceeded at any node during any increment of the step.

If the maximum allowable temperature change is not specified, there is no restriction on the maximum temperature change in an increment.

POREPTOL

This parameter is valid only in a coupled thermal-electrochemical-structural–pore pressure analysis.

Set this parameter equal to the maximum pore pressure change allowed in an increment. Abaqus/Standard restricts the time step to ensure that this value is not exceeded at any node during any increment of the step.

If the maximum allowable pore pressure change is not specified, there is no restriction on the maximum pore pressure change in an increment.

Data line to control incrementation in a fully coupled thermal-stress analysis

First (and only) line

  1. Suggested initial time increment. If automatic incrementation is used, this should be a reasonable suggestion for the initial increment size and will be adjusted as necessary. If direct incrementation is used, this will be the fixed time increment size.

  2. Total time period for the step.

  3. Minimum time increment allowed. If Abaqus/Standard finds it needs a smaller time increment than this value, the analysis is terminated. If this entry is zero, a default value of the smaller of the suggested initial time increment or 10−5 times the total time period is assumed. This value is used only for automatic time incrementation.

  4. Maximum time increment allowed. If this value is not specified, the default upper limit is the total time period for the step. This value is used only for automatic time incrementation.